zhyang-dev/OpenFOAM-12
1
0
Fork 0
Code Issues Pull Requests Actions Packages Projects Releases Wiki Activity

functionObjects::comfort: New functionObject to calculate fields relating to thermal comfort

Browse Source 
Description
    Calculates the thermal comfort quantities predicted mean vote (PMV) and
    predicted percentage of dissatisfaction (PPD) based on DIN ISO EN 7730:2005.

Usage
    \table
        Property      | Description                  | Required  | Default value
        clothing      | The insulation value of the cloth | no   | 0
        metabolicRate | The metabolic rate      | no        | 0.8
        extWork       | The external work        | no        | 0
        Trad          | Radiation temperature | no | -1
        relHumidity   | Relative humidity of the air | no | 50
        pSat          | Saturation pressure of water | no | -1
        tolerance     | Residual control for the cloth temperature | no | 1e-5
        maxClothIter  | Maximum number of iterations | no       | 0
        meanVelocity  | Use a constant mean velocity in the whole domain | no |\
        false
    \endtable

    \table
        Predicted Mean Vote (PMV)   | evaluation
        + 3                         | hot
        + 2                         | warm
        + 1                         | slightly warm
        + 0                         | neutral
        - 1                         | slightly cool
        - 2                         | cool
        - 3                         | cold
    \endtable

    \verbatim
    comfortAnalysis
    {
        type            comfort;
        libs            ("libfieldFunctionObjects.so");

        executeControl  writeTime;
        writeControl    writeTime;
    }
    \endverbatim

The new tutorial case heatTransfer/buoyantSimpleFoam/comfortHotRoom is provided
to demonstrate the calculation of PMV and PPD using the comfort functionObject.

This work is based on code and case contributed by Tobias Holzmann.
This commit is contained in:
Henry Weller
2019-10-19 23:08:34 +01:00
parent 9b21cf6993
commit 280c055ef6
22 changed files with 1453 additions and 3 deletions
Download Patch File Download Diff File Expand all files Collapse all files

42
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/T Normal file
View File

@ -0,0 +1,42 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object T;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 0 0 1 0 0 0];
internalField uniform 302;
boundaryField
{
walls
{
type fixedValue;
value $internalField;
}
inlet
{
type fixedValue;
value uniform 290;
}
outlet
{
type zeroGradient;
}
}
// ************************************************************************* //

42
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/U Normal file
View File

@ -0,0 +1,42 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volVectorField;
object U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -1 0 0 0 0];
internalField uniform (0 0 0);
boundaryField
{
walls
{
type noSlip;
}
inlet
{
type fixedValue;
value uniform (0.2 0 0);
}
outlet
{
type pressureInletOutletVelocity;
value $internalField;
}
}
// ************************************************************************* //

44
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/alphat Normal file
View File

@ -0,0 +1,44 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object alphat;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [1 -1 -1 0 0 0 0];
internalField uniform 0;
boundaryField
{
walls
{
type compressible::alphatJayatillekeWallFunction;
Prt 0.85;
value $internalField;
}
inlet
{
type calculated;
value $internalField;
}
outlet
{
type calculated;
value $internalField;
}
}
// ************************************************************************* //

45
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/epsilon Normal file
View File

@ -0,0 +1,45 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
location "0";
object epsilon;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 2 -3 0 0 0 0];
internalField uniform 0.23;
boundaryField
{
walls
{
type epsilonWallFunction;
value $internalField;
}
inlet
{
type turbulentMixingLengthDissipationRateInlet;
mixingLength 0.0168;
value $internalField;
}
outlet
{
type inletOutlet;
inletValue $internalField;
}
}
// ************************************************************************* //

45
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/k Normal file
View File

@ -0,0 +1,45 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
location "0";
object k;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 2 -2 0 0 0 0];
internalField uniform 8e-2;
boundaryField
{
walls
{
type kqRWallFunction;
value $internalField;
}
inlet
{
type turbulentIntensityKineticEnergyInlet;
intensity 0.14;
value $internalField;
}
outlet
{
type inletOutlet;
inletValue $internalField;
}
}
// ************************************************************************* //

43
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/nut Normal file
View File

@ -0,0 +1,43 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object nut;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 2 -1 0 0 0 0];
internalField uniform 0;
boundaryField
{
walls
{
type nutkWallFunction;
value $internalField;
}
inlet
{
type calculated;
value $internalField;
}
outlet
{
type calculated;
value $internalField;
}
}
// ************************************************************************* //

42
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/p Normal file
View File

@ -0,0 +1,42 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object p;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [1 -1 -2 0 0 0 0];
internalField uniform 1e5;
boundaryField
{
walls
{
type calculated;
value $internalField;
}
inlet
{
type calculated;
value $internalField;
}
outlet
{
type calculated;
value $internalField;
}
}
// ************************************************************************* //

43
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/0/p_rgh Normal file
View File

@ -0,0 +1,43 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object p_rgh;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [1 -1 -2 0 0 0 0];
internalField uniform 1e5;
boundaryField
{
walls
{
type fixedFluxPressure;
value $internalField;
}
outlet
{
type prghPressure;
p $internalField;
value $internalField;
}
inlet
{
type fixedFluxPressure;
value $internalField;
}
}
// ************************************************************************* //

15
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/Allrun Executable file
View File

@ -0,0 +1,15 @@
#!/bin/sh
cd ${0%/*} || exit 1 # Run from this directory
# Source tutorial run functions
. $WM_PROJECT_DIR/bin/tools/RunFunctions
# Get application name
application=$(getApplication)
runApplication blockMesh
runApplication topoSet
runApplication createPatch -overwrite
runApplication $application
#------------------------------------------------------------------------------

21
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/constant/g Normal file
View File

@ -0,0 +1,21 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class uniformDimensionedVectorField;
location "constant";
object g;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -2 0 0 0 0];
value (0 0 -9.81);
// ************************************************************************* //

54
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/constant/thermophysicalProperties Normal file
View File

@ -0,0 +1,54 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object thermophysicalProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
thermoType
{
type heRhoThermo;
mixture pureMixture;
transport const;
thermo eConst;
equationOfState Boussinesq;
specie specie;
energy sensibleInternalEnergy;
}
mixture
{
specie
{
molWeight 28.9;
}
equationOfState
{
rho0 1;
T0 300;
beta 3e-03;
}
thermodynamics
{
Cv 712;
Hf 0;
}
transport
{
mu 1e-05;
Pr 0.7;
}
}
// ************************************************************************* //

30
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/constant/turbulenceProperties Normal file
View File

@ -0,0 +1,30 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object turbulenceProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
simulationType RAS;
RAS
{
RASModel kEpsilon;
turbulence on;
printCoeffs on;
}
// ************************************************************************* //

49
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/blockMeshDict Normal file
View File

@ -0,0 +1,49 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object blockMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
convertToMeters 1;
vertices
(
(0 0 0)
(0 0 1.6)
(0 3 1.6)
(0 3 0)
(4 0 0)
(4 0 1.6)
(4 3 1.6)
(4 3 0)
);
blocks
(
hex (0 3 2 1 4 7 6 5)
(40 20 60)
simpleGrading (1 1 1)
);
defaultPatch
{
name walls;
type wall;
}
boundary
();
// ************************************************************************* //

76
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/controlDict Normal file
View File

@ -0,0 +1,76 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object controlDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
application buoyantSimpleFoam;
startFrom startTime;
startTime 0;
stopAt endTime;
endTime 3000;
deltaT 1;
writeControl timeStep;
writeInterval 100;
purgeWrite 0;
writeFormat binary;
writePrecision 6;
writeCompression off;
timeFormat general;
timePrecision 6;
runTimeModifiable true;
functions
{
age
{
libs ("libfieldFunctionObjects.so");
type age;
diffusion on;
writeControl writeTime;
executeControl writeTime;
}
comfort
{
libs ("libfieldFunctionObjects.so");
type comfort;
clothing 0.5;
metabolicRate 1.2;
extWork 0;
relHumidity 60;
writeControl writeTime;
executeControl writeTime;
}
}
// ************************************************************************* //

47
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/createPatchDict Normal file
View File

@ -0,0 +1,47 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object createPatchDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
pointSync false;
writeCyclicMatch false;
patches
(
{
name inlet;
patchInfo
{
type patch;
}
constructFrom set;
set inlet;
}
{
name outlet;
patchInfo
{
type patch;
}
constructFrom set;
set outlet;
}
);
// ************************************************************************* //

61
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/fvSchemes Normal file
View File

@ -0,0 +1,61 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSchemes;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
ddtSchemes
{
default steadyState;
}
gradSchemes
{
default Gauss linear;
}
divSchemes
{
default none;
div(phi,U) bounded Gauss upwind;
div(phi,e) bounded Gauss upwind;
div(phi,k) bounded Gauss upwind;
div(phi,epsilon) bounded Gauss upwind;
div(phi,Ekp) bounded Gauss linear;
div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
div(phi,age) bounded Gauss upwind;
}
laplacianSchemes
{
default Gauss linear orthogonal;
}
interpolationSchemes
{
default linear;
}
snGradSchemes
{
default orthogonal;
}
// ************************************************************************* //

74
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/fvSolution Normal file
View File

@ -0,0 +1,74 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSolution;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
solvers
{
p_rgh
{
solver PCG;
preconditioner DIC;
tolerance 1e-8;
relTol 0.01;
}
"(U|e|k|epsilon)"
{
solver PBiCGStab;
preconditioner DILU;
tolerance 1e-7;
relTol 0.1;
}
age
{
$U;
relTol 0.001;
}
}
SIMPLE
{
nNonOrthogonalCorrectors 0;
residualControl
{
p_rgh 1e-2;
U 1e-4;
e 1e-2;
"(k|epsilon|omega)" 1e-3;
}
}
relaxationFactors
{
fields
{
p_rgh 0.7;
}
equations
{
U 0.2;
e 0.1;
"(k|epsilon|R)" 0.7;
age 1;
}
}
// ************************************************************************* //

41
tutorials/heatTransfer/buoyantSimpleFoam/comfortHotRoom/system/topoSetDict Normal file
View File

@ -0,0 +1,41 @@
/*--------------------------------*- C++ -*----------------------------------*\
========= |
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
\\ / O peration | Website: https://openfoam.org
\\ / A nd | Version: dev
\\/ M anipulation |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object topoSetDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
actions
(
{
name inlet;
type faceSet;
action new;
source boxToFace;
sourceInfo
{
box (-0.001 0.25 1.1)(0.001 0.75 1.3);
}
}
{
name outlet;
type faceSet;
action new;
source boxToFace;
sourceInfo
{
box (1.75 2.999 0.3)(2.25 3.001 0.5);
}
}
);
// ************************************************************************* //