tutorials: CHT version of circuitBoardCooling

This is a better way of doing 3D thermal baffles. It does not require a
special region model and is consistent with multi-region handling in
other parts of OpenFOAM.

tutorials/modules/CHT/circuitBoardCooling/0/baffle3D/T

@@ -0,0 +1,40 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      T;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 0 0 1 0 0 0];
+
+internalField   uniform 300;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|baffle3D0|baffle3D1|baffle3D_side)"
+    {
+        type            zeroGradient;
+    }
+
+    "baffle3D_to_fluid_.*"
+    {
+        type            compressible::turbulentTemperatureCoupledBaffleMixed;
+        kappa           kappa;
+        Tnbr            T;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/T.orig

@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      T;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 0 0 1 0 0 0];
+
+internalField   uniform 300;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling)"
+    {
+        type            zeroGradient;
+    }
+
+    "fluid_to_baffle3D_.*"
+    {
+        type            compressible::turbulentTemperatureCoupledBaffleMixed;
+        kappa           kappa;
+        Tnbr            T;
+        value           $internalField;
+    }
+
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+
+    outlet
+    {
+        type            inletOutlet;
+        inletValue      $internalField;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/U.orig

@@ -0,0 +1,44 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volVectorField;
+    location    "0";
+    object      U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 1 -1 0 0 0 0];
+
+internalField   uniform (0.1 0 0);
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            noSlip;
+    }
+
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+
+    outlet
+    {
+        type            pressureInletOutletVelocity;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/alphat.orig

@@ -0,0 +1,40 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      alphat;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [1 -1 -1 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            compressible::alphatWallFunction;
+        Prt             0.85;
+        value           $internalField;
+    }
+
+    "(inlet|outlet)"
+    {
+        type            calculated;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/epsilon.orig

@@ -0,0 +1,44 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -3 0 0 0 0];
+
+internalField   uniform 0.01;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            epsilonWallFunction;
+        value           $internalField;
+    }
+
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+
+    outlet
+    {
+        type            zeroGradient;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/k.orig

@@ -0,0 +1,44 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -2 0 0 0 0];
+
+internalField   uniform 0.1;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            kqRWallFunction;
+        value           $internalField;
+    }
+
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+
+    outlet
+    {
+        type            zeroGradient;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/nut.orig

@@ -0,0 +1,39 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -1 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            nutkWallFunction;
+        value           $internalField;
+    }
+
+    "(inlet|outlet)"
+    {
+        type            calculated;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/p.orig

@@ -0,0 +1,33 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [1 -1 -2 0 0 0 0];
+
+internalField   uniform 1e5;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    ".*"
+    {
+        type            calculated;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/0/fluid/p_rgh.orig

@@ -0,0 +1,45 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      p_rgh;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [1 -1 -2 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    #includeEtc "caseDicts/setConstraintTypes"
+
+    "(floor|ceiling|fluid_to_baffle3D_.*)"
+    {
+        type            fixedFluxPressure;
+        value           $internalField;
+    }
+
+    inlet
+    {
+        type            fixedFluxPressure;
+        value           $internalField;
+    }
+
+    outlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/Allrun

@@ -0,0 +1,20 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # Run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+runApplication blockMesh -region fluid
+
+# Create the 3D baffle
+runApplication topoSet -region fluid
+runApplication extrudeToRegionMesh -region fluid -overwrite
+
+# Create the 1D baffle
+runApplication createBaffles -region fluid -overwrite
+
+runApplication $(getApplication)
+
+paraFoam -touchAll
+
+#------------------------------------------------------------------------------

tutorials/modules/CHT/circuitBoardCooling/constant/baffle3D/fvModels

@@ -0,0 +1,25 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      fvModels;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+cylinderHeat
+{
+    type            heatSource;
+
+    selectionMode   all;
+
+    q               17000;
+}
+
+//************************************************************************** //

tutorials/modules/CHT/circuitBoardCooling/constant/baffle3D/physicalProperties

@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "constant/baffle3D";
+    object      physicalProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+    type            heSolidThermo;
+    mixture         pureMixture;
+    transport       constIsoSolid;
+    thermo          eConst;
+    equationOfState rhoConst;
+    specie          specie;
+    energy          sensibleInternalEnergy;
+}
+
+mixture
+{
+    specie
+    {
+        molWeight       20;
+    }
+    transport
+    {
+        kappa           0.01;
+    }
+    thermodynamics
+    {
+        Hf              0;
+        Cv              15;
+    }
+    equationOfState
+    {
+        rho             80;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/constant/fluid/g

@@ -0,0 +1,21 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       uniformDimensionedVectorField;
+    location    "constant";
+    object      g;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 1 -2 0 0 0 0];
+value           (0 -9.81 0);
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/constant/fluid/momentumTransport

@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      RASProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+    model               kEpsilon;
+
+    turbulence          on;
+
+    printCoeffs         on;
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/constant/fluid/pRef

@@ -0,0 +1,20 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       uniformDimensionedScalarField;
+    location    "constant";
+    object      pRef;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [1 -1 -2 0 0 0 0];
+value           1e5;
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/constant/fluid/physicalProperties

@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "constant/fluid";
+    object      physicalProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+    type            heRhoThermo;
+    mixture         pureMixture;
+    transport       const;
+    thermo          hConst;
+    equationOfState perfectGas;
+    specie          specie;
+    energy          sensibleEnthalpy;
+}
+
+mixture
+{
+    specie
+    {
+        molWeight       28.96;
+    }
+    thermodynamics
+    {
+        Cp              1004.4;
+        Hf              0;
+    }
+    transport
+    {
+        mu              1.831e-05;
+        Pr              0.705;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/constant/geometry/baffle1D.stl

@@ -0,0 +1,16 @@
+solid ascii
+ facet normal -1 0 0
+  outer loop
+   vertex 0.3 0 0
+   vertex 0.3 0 0.1
+   vertex 0.3 0.2 0
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.3 0.2 0.1
+   vertex 0.3 0.2 0
+   vertex 0.3 0 0.1
+  endloop
+ endfacet
+endsolid

tutorials/modules/CHT/circuitBoardCooling/constant/geometry/baffle3D.stl

@@ -0,0 +1,58 @@
+solid ascii
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0 0
+   vertex 0.59 0 0.05
+   vertex 0.59 0.1 0
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.1 0.05
+   vertex 0.59 0.1 0
+   vertex 0.59 0 0.05
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0 0.05
+   vertex 0.59 0 0.1
+   vertex 0.59 0.1 0.05
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.1 0.1
+   vertex 0.59 0.1 0.05
+   vertex 0.59 0 0.1
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.1 0
+   vertex 0.59 0.1 0.05
+   vertex 0.59 0.2 0
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.2 0.05
+   vertex 0.59 0.2 0
+   vertex 0.59 0.1 0.05
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.1 0.05
+   vertex 0.59 0.1 0.1
+   vertex 0.59 0.2 0.05
+  endloop
+ endfacet
+ facet normal -1 0 0
+  outer loop
+   vertex 0.59 0.2 0.1
+   vertex 0.59 0.2 0.05
+   vertex 0.59 0.1 0.1
+  endloop
+ endfacet
+endsolid

tutorials/modules/CHT/circuitBoardCooling/include/wallPatchFields

@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+
+alphat
+{
+    type            compressible::alphatWallFunction;
+    value           uniform 0;
+}
+
+epsilon
+{
+    type            epsilonWallFunction;
+    value           uniform 0.01;
+}
+
+k
+{
+    type            kqRWallFunction;
+    value           uniform 0.01;
+}
+
+nut
+{
+    type            nutkWallFunction;
+    value           uniform 0;
+}
+
+p
+{
+    type            calculated;
+    value           uniform 101325;
+}
+
+p_rgh
+{
+    type            fixedFluxPressure;
+}
+
+U
+{
+    type            fixedValue;
+    value           uniform (0 0 0);
+}
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/baffle3D/fvSchemes

@@ -0,0 +1,48 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "system/baffleRegion";
+    object      fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+    default         steadyState;
+}
+
+gradSchemes
+{
+    default         Gauss linear;
+}
+
+divSchemes
+{
+    default         none;
+}
+
+laplacianSchemes
+{
+    default         Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+    default         linear;
+}
+
+snGradSchemes
+{
+    default         uncorrected;
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/baffle3D/fvSolution

@@ -0,0 +1,35 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "system/baffleRegion";
+    object      fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+    "e.*"
+    {
+        solver           PCG;
+        smoother         GaussSeidel;
+        preconditioner   DIC;
+        tolerance        1e-06;
+        relTol           0;
+    }
+}
+
+PIMPLE
+{
+    nNonOrthogonalCorrectors 0;
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/controlDict

@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application     foamMultiRun;
+
+regionSolvers
+{
+    fluid           fluid;
+    baffle3D        solid;
+}
+
+startFrom       startTime;
+
+startTime       0;
+
+stopAt          endTime;
+
+endTime         2500;
+
+deltaT          1;
+
+writeControl    timeStep;
+
+writeInterval   500;
+
+purgeWrite      0;
+
+writeFormat     ascii;
+
+writePrecision  6;
+
+writeCompression off;
+
+timeFormat      general;
+
+timePrecision   6;
+
+runTimeModifiable true;
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/blockMeshDict

@@ -0,0 +1,85 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+convertToMeters 0.1;
+
+vertices
+(
+    (0 0 0)
+    (10 0 0)
+    (10 5 0)
+    (0 5 0)
+    (0 0 1)
+    (10 0 1)
+    (10 5 1)
+    (0 5 1)
+);
+
+blocks
+(
+    hex (0 1 2 3 4 5 6 7) (50 40 1) simpleGrading (1 1 1)
+);
+
+boundary
+(
+    floor
+    {
+        type wall;
+        faces
+        (
+            (1 5 4 0)
+        );
+    }
+
+    ceiling
+    {
+        type wall;
+        faces
+        (
+            (2 6 7 3)
+        );
+    }
+
+    inlet
+    {
+        type patch;
+        faces
+        (
+            (0 4 7 3)
+        );
+    }
+
+    outlet
+    {
+        type patch;
+        faces
+        (
+            (1 5 6 2)
+        );
+    }
+
+    fixedWalls
+    {
+        type empty;
+        faces
+        (
+            (0 3 2 1)
+            (4 5 6 7)
+        );
+    }
+);
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/createBafflesDict

@@ -0,0 +1,94 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      createBafflesDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+internalFacesOnly true;
+
+fields true;
+
+baffles
+{
+    baffle1D
+    {
+        type        searchableSurface;
+        surface     triSurfaceMesh;
+        name        baffle1D.stl;
+
+        owner
+        {
+            name        baffle1D0;
+            type        mappedWall;
+            sampleMode  nearestPatchFace;
+            samplePatch baffle1D1;
+
+            patchFields
+            {
+                #include "./include/wallPatchFields"
+
+                T
+                {
+                    type        compressible::thermalBaffle1D<eConstSolidThermoPhysics>;
+                    value       uniform 300;
+
+                    // Baffle thickness [m]
+                    thickness   uniform 0.005;
+
+                    // Baffle source heat flux [W/m^2]
+                    qs          uniform 100;
+
+                    // Baffle physical properties
+                    specie
+                    {
+                        molWeight   20;
+                    }
+                    transport
+                    {
+                        kappa       1;
+                    }
+                    thermodynamics
+                    {
+                        Hf          0;
+                        Cv          10;
+                    }
+                    equationOfState
+                    {
+                        rho         10;
+                    }
+                }
+            }
+        }
+
+        neighbour
+        {
+            name        baffle1D1;
+            type        mappedWall;
+            sampleMode  nearestPatchFace;
+            samplePatch baffle1D0;
+
+            patchFields
+            {
+                #include "./include/wallPatchFields"
+
+                T
+                {
+                    type        compressible::thermalBaffle1D<eConstSolidThermoPhysics>;
+                    value       uniform 300;
+                }
+            }
+        }
+    }
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/extrudeToRegionMeshDict

@@ -0,0 +1,33 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      extrudeToRegionMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+region          baffle3D;
+
+faceZones       (baffle3D);
+
+extrudeModel    linearNormal;
+
+nLayers         50;
+
+expansionRatio  1;
+
+adaptMesh       yes; // apply mapped to both regions
+
+linearNormalCoeffs
+{
+    thickness       0.02;
+}
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/fvSchemes

@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+    default     steadyState;
+}
+
+gradSchemes
+{
+    default     Gauss linear;
+}
+
+divSchemes
+{
+    default         none;
+    div(phi,U)      bounded Gauss limitedLinear 0.2;
+    div(phi,K)      bounded Gauss limitedLinear 0.2;
+    div(phi,h)      bounded Gauss limitedLinear 0.2;
+    div(phi,k)      bounded Gauss limitedLinear 0.2;
+    div(phi,epsilon) bounded Gauss limitedLinear 0.2;
+    div(phi,omega) bounded Gauss limitedLinear 0.2;
+    div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+    default         Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+    default         linear;
+}
+
+snGradSchemes
+{
+    default         uncorrected;
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/fvSolution

@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "system";
+    object      fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+    p_rgh
+    {
+        solver           GAMG;
+        tolerance        1e-7;
+        relTol           0.01;
+
+        smoother         DICGaussSeidel;
+
+    }
+
+    "(U|h|k|epsilon|omega)"
+    {
+        solver          PBiCGStab;
+        preconditioner  DILU;
+        tolerance       1e-7;
+        relTol          0.01;
+    }
+}
+
+PIMPLE
+{
+    momentumPredictor no;
+    nNonOrthogonalCorrectors 0;
+    pRefCell        0;
+    pRefValue       0;
+
+    residualControl
+    {
+        p_rgh           1e-3;
+        U               1e-4;
+        h               1e-4;
+
+        // possibly check turbulence fields
+        "(k|epsilon|omega)" 5e-3;
+    }
+}
+
+relaxationFactors
+{
+    rho             1.0;
+    p_rgh           0.7;
+    U               0.3;
+    h               0.7;
+    "(k|epsilon|omega)" 0.3;
+}
+
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fluid/topoSetDict

@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    object      topoSetDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+actions
+(
+    {
+        action  new;
+        type    faceZoneSet;
+        name    baffle3D;
+        source  searchableSurfaceToFaceZone;
+        surface triSurfaceMesh;
+        file    "baffle3D.stl";
+    }
+);
+
+// ************************************************************************* //

tutorials/modules/CHT/circuitBoardCooling/system/fvSolution

@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+  =========                 |
+  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
+   \\    /   O peration     | Website:  https://openfoam.org
+    \\  /    A nd           | Version:  dev
+     \\/     M anipulation  |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    format      ascii;
+    class       dictionary;
+    location    "system";
+    object      fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+PIMPLE
+{
+    nOuterCorrectors 1;
+}
+
+// ************************************************************************* //