fvOptions: Added volumeFractionSource and solidEquilibriumEnergySource
The volumeFractionSource represents the effect of a reduction in the
volume of the domain due to the presence of a stationary phase, most
likely a solid porous media. It only represents the dynamic effects
associated with the reduction in volume; it does not does not model
loss, drag or heat transfer. Separate models (e.g., the existing
porosity models) will be necessary to represent these effects. An
example usage, in system/fvOptions, is as follows:
volumeFraction
{
type volumeFractionSource;
phase solid;
phi phi;
rho rho;
U U;
fields (rho U e);
}
The volume fraction will be read from constant/alpha.<phase>, and must
be generated in advance using setFields or a function object. Note that
the names of the flux, density (if compressible) and velocity must all
be specified. Every field for which a transport equation is solved
should also be specified in the "fields" entry.
The solidEquilibriumEnergySource adds the thermal inertia and diffusive
characteristics of a stationary solid phase to the energy equation of
the fluid, assuming that the two phases are in thermal equilibrium. An
example usage is as follows:
solidEqulibriumEnergy
{
type solidEqulibriumEnergySource;
phase solid;
field e;
}
This will read the volume fraction in the same way as the
volumeFractionSource option. In addition, thermal properties of the
solid will be constructed from settings in
system/thermophysicalProperties.<phase>.
Two tutorials have been added, demonstrating use of these options in
both incompressible and compressible simulations. These are
incompressible/pimpleFoam/laminar/blockedChannel and
compressible/rhoPimpleFoam/laminar/blockedChannel.
This commit is contained in:
Will Bainbridge
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object T;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 0 0 1 0 0 0];
|
||||
|
||||
internalField uniform 300;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type fixedValue;
|
||||
value uniform 400;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,32 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object T.solid;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 0 0 1 0 0 0];
|
||||
|
||||
internalField uniform 300;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
".*"
|
||||
{
|
||||
type calculated;
|
||||
value $internalField;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volVectorField;
|
||||
location "0";
|
||||
object U;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 1 -1 0 0 0 0];
|
||||
|
||||
internalField uniform (10 0 0);
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type fixedValue;
|
||||
value $internalField;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type noSlip;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object p;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [1 -1 -2 0 0 0 0];
|
||||
|
||||
internalField uniform 1e5;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type fixedValue;
|
||||
value $internalField;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object tracer;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 0 0 0 0 0 0];
|
||||
|
||||
internalField uniform 0;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type fixedValue;
|
||||
value uniform 1;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
7
tutorials/compressible/rhoPimpleFoam/laminar/blockedChannel/Allclean
Executable file
7
tutorials/compressible/rhoPimpleFoam/laminar/blockedChannel/Allclean
Executable file
@ -0,0 +1,7 @@
|
||||
#!/bin/sh
|
||||
|
||||
cd ${0%/*} || exit 1
|
||||
|
||||
. $WM_PROJECT_DIR/bin/tools/CleanFunctions
|
||||
|
||||
cleanCase && rm -f constant/alpha.solid
|
||||
9
tutorials/compressible/rhoPimpleFoam/laminar/blockedChannel/Allrun
Executable file
9
tutorials/compressible/rhoPimpleFoam/laminar/blockedChannel/Allrun
Executable file
@ -0,0 +1,9 @@
|
||||
#!/bin/sh
|
||||
|
||||
cd ${0%/*} || exit 1
|
||||
|
||||
. $WM_PROJECT_DIR/bin/tools/RunFunctions
|
||||
|
||||
runApplication blockMesh
|
||||
runApplication postProcess -func generateAlphaSolid
|
||||
runApplication $(getApplication)
|
||||
@ -0,0 +1,49 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object thermophysicalProperties;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
thermoType
|
||||
{
|
||||
type hePsiThermo;
|
||||
mixture pureMixture;
|
||||
transport const;
|
||||
thermo eConst;
|
||||
equationOfState perfectGas;
|
||||
specie specie;
|
||||
energy sensibleInternalEnergy;
|
||||
}
|
||||
|
||||
mixture
|
||||
{
|
||||
specie
|
||||
{
|
||||
molWeight 28.9;
|
||||
}
|
||||
thermodynamics
|
||||
{
|
||||
Cv 712;
|
||||
Cp 1005;
|
||||
Hf 0;
|
||||
}
|
||||
transport
|
||||
{
|
||||
mu 1.8e-05;
|
||||
Pr 0.7;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,50 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object thermophysicalProperties.solid;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
thermoType
|
||||
{
|
||||
type heSolidThermo;
|
||||
mixture pureMixture;
|
||||
transport constIso;
|
||||
thermo hConst;
|
||||
equationOfState rhoConst;
|
||||
specie specie;
|
||||
energy sensibleEnthalpy;
|
||||
}
|
||||
|
||||
mixture
|
||||
{
|
||||
specie
|
||||
{
|
||||
molWeight 1;
|
||||
}
|
||||
equationOfState
|
||||
{
|
||||
rho 900;
|
||||
}
|
||||
thermodynamics
|
||||
{
|
||||
Hf 0;
|
||||
Cp 1900;
|
||||
}
|
||||
transport
|
||||
{
|
||||
kappa 0.5;
|
||||
}
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,22 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object transportProperties;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
transportModel Newtonian;
|
||||
|
||||
nu [0 2 -1 0 0 0 0] 1e-05;
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,20 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object turbulenceProperties;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
simulationType laminar;
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,111 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
object blockMeshDict;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
convertToMeters 0.001;
|
||||
|
||||
vertices
|
||||
(
|
||||
(0 -16 -1) (256 -16 -1)
|
||||
(0 16 -1) (256 16 -1)
|
||||
(0 -16 1) (256 -16 1)
|
||||
(0 16 1) (256 16 1)
|
||||
|
||||
(0 -52 -1) ( 32 -52 -1) (64 -44 -1) (128 -44 -1) (224 -52 -1) (256 -52 -1)
|
||||
(0 -20 -1) ( 32 -20 -1) (64 -28 -1) (128 -28 -1) (224 -20 -1) (256 -20 -1)
|
||||
(0 -52 1) ( 32 -52 1) (64 -44 1) (128 -44 1) (224 -52 1) (256 -52 1)
|
||||
(0 -20 1) ( 32 -20 1) (64 -28 1) (128 -28 1) (224 -20 1) (256 -20 1)
|
||||
|
||||
(0 -88 -1) (256 -88 -1)
|
||||
(0 -56 -1) (256 -56 -1)
|
||||
(0 -88 1) (256 -88 1)
|
||||
(0 -56 1) (256 -56 1)
|
||||
);
|
||||
|
||||
blocks
|
||||
(
|
||||
hex (0 1 3 2 4 5 7 6) (256 32 1) simpleGrading (1 1 1)
|
||||
|
||||
hex (8 9 15 14 20 21 27 26) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (9 10 16 15 21 22 28 27) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (10 11 17 16 22 23 29 28) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (11 12 18 17 23 24 30 29) (96 32 1) simpleGrading (1 1 1)
|
||||
hex (12 13 19 18 24 25 31 30) (64 32 1) simpleGrading (1 1 1)
|
||||
|
||||
hex (32 33 35 34 36 37 39 38) (256 32 1) simpleGrading (1 1 1)
|
||||
);
|
||||
|
||||
edges
|
||||
(
|
||||
);
|
||||
|
||||
defaultPatch
|
||||
{
|
||||
name frontAndBack;
|
||||
type empty;
|
||||
}
|
||||
|
||||
boundary
|
||||
(
|
||||
inlet
|
||||
{
|
||||
type patch;
|
||||
faces
|
||||
(
|
||||
(0 2 6 4)
|
||||
|
||||
(8 14 26 20)
|
||||
|
||||
(32 34 38 36)
|
||||
);
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type patch;
|
||||
faces
|
||||
(
|
||||
(1 3 7 5)
|
||||
|
||||
(13 19 31 25)
|
||||
|
||||
(33 35 39 37)
|
||||
);
|
||||
}
|
||||
walls
|
||||
{
|
||||
type wall;
|
||||
faces
|
||||
(
|
||||
(0 1 5 4)
|
||||
(2 3 7 6)
|
||||
|
||||
(8 9 21 20)
|
||||
(9 10 22 21)
|
||||
(10 11 23 22)
|
||||
(11 12 24 23)
|
||||
(12 13 25 24)
|
||||
(14 15 27 26)
|
||||
(15 16 28 27)
|
||||
(16 17 29 28)
|
||||
(17 18 30 29)
|
||||
(18 19 31 30)
|
||||
|
||||
(32 33 37 36)
|
||||
(34 35 39 38)
|
||||
);
|
||||
}
|
||||
);
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,57 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object controlDict;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
application rhoPimpleFoam;
|
||||
|
||||
startFrom latestTime;
|
||||
|
||||
startTime 0;
|
||||
|
||||
stopAt endTime;
|
||||
|
||||
endTime 0.03;
|
||||
|
||||
deltaT 0.0001;
|
||||
|
||||
writeControl adjustableRunTime;
|
||||
|
||||
writeInterval 0.001;
|
||||
|
||||
purgeWrite 0;
|
||||
|
||||
writeFormat ascii;
|
||||
|
||||
writePrecision 6;
|
||||
|
||||
writeCompression off;
|
||||
|
||||
timeFormat general;
|
||||
|
||||
timePrecision 6;
|
||||
|
||||
runTimeModifiable yes;
|
||||
|
||||
adjustTimeStep yes;
|
||||
|
||||
maxCo 5;
|
||||
|
||||
functions
|
||||
{
|
||||
#includeFunc scalarTransport
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,35 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object fvOptions;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
volumeFraction
|
||||
{
|
||||
type volumeFractionSource;
|
||||
phase solid;
|
||||
phi phi;
|
||||
rho rho;
|
||||
U U;
|
||||
fields (rho U e);
|
||||
}
|
||||
|
||||
solidEqulibriumEnergy
|
||||
{
|
||||
type solidEqulibriumEnergySource;
|
||||
phase solid;
|
||||
field e;
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,56 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object fvSchemes;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
ddtSchemes
|
||||
{
|
||||
default Euler;
|
||||
}
|
||||
|
||||
gradSchemes
|
||||
{
|
||||
default Gauss linear;
|
||||
limited cellLimited Gauss linear 1;
|
||||
}
|
||||
|
||||
divSchemes
|
||||
{
|
||||
default none;
|
||||
div(phi,U) Gauss linearUpwind limited;
|
||||
div(phi,e) Gauss linearUpwind limited;
|
||||
div(phi,tracer) Gauss linearUpwind limited;
|
||||
div(phi,K) Gauss linear;
|
||||
div(phiv,p) Gauss linear;
|
||||
div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
|
||||
}
|
||||
|
||||
laplacianSchemes
|
||||
{
|
||||
default Gauss linear corrected;
|
||||
}
|
||||
|
||||
interpolationSchemes
|
||||
{
|
||||
default linear;
|
||||
}
|
||||
|
||||
snGradSchemes
|
||||
{
|
||||
default corrected;
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,61 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object fvSolution;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
solvers
|
||||
{
|
||||
"rho.*"
|
||||
{
|
||||
solver diagonal;
|
||||
}
|
||||
|
||||
p
|
||||
{
|
||||
solver GAMG;
|
||||
smoother DICGaussSeidel;
|
||||
tolerance 1e-7;
|
||||
relTol 0.01;
|
||||
}
|
||||
|
||||
pFinal
|
||||
{
|
||||
$p;
|
||||
relTol 0;
|
||||
}
|
||||
|
||||
"(U|e|tracer)"
|
||||
{
|
||||
solver PBiCGStab;
|
||||
preconditioner DILU;
|
||||
tolerance 1e-05;
|
||||
relTol 0.1;
|
||||
}
|
||||
|
||||
"(U|e|tracer)Final"
|
||||
{
|
||||
$U;
|
||||
relTol 0;
|
||||
}
|
||||
}
|
||||
|
||||
PIMPLE
|
||||
{
|
||||
nNonOrthogonalCorrectors 0;
|
||||
nCorrectors 2;
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,49 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
|
||||
type coded;
|
||||
libs ("libutilityFunctionObjects.so");
|
||||
|
||||
name generateAlphaSolid;
|
||||
|
||||
codeWrite
|
||||
#{
|
||||
const dimensionedVector dx(dimless/dimLength, vector(1, 0, 0));
|
||||
const dimensionedVector dy(dimless/dimLength, vector(0, 1, 0));
|
||||
|
||||
const volScalarField x(mesh().C() & dx), y(mesh().C() & dy);
|
||||
|
||||
const scalar x0 = 0.032, x1 = 0.064, x2 = 0.128, x3 = 0.224;
|
||||
const scalar y0 = -0.088, y1 = -0.056;
|
||||
|
||||
volScalarField alpha
|
||||
(
|
||||
IOobject
|
||||
(
|
||||
IOobject::groupName("alpha", "solid"),
|
||||
mesh().time().constant(),
|
||||
mesh()
|
||||
),
|
||||
mesh(),
|
||||
dimless,
|
||||
zeroGradientFvPatchScalarField::typeName
|
||||
);
|
||||
|
||||
alpha =
|
||||
0.5
|
||||
*(
|
||||
pos(x - x0)*pos(x1 - x)*(x - x0)/(x1 - x0)
|
||||
+ pos(x - x1)*pos(x2 - x)
|
||||
+ pos(x - x2)*pos(x3 - x)*(x3 - x)/(x3 - x2)
|
||||
)
|
||||
*pos(y - y0)*pos(y1 - y);
|
||||
|
||||
alpha.write();
|
||||
#};
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,34 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
-------------------------------------------------------------------------------
|
||||
Description
|
||||
Solves a transport equation for a scalar field.
|
||||
|
||||
The name of the scalar field is specified in this file. A sample scalar
|
||||
field file, that must be initialised for the case, typically in the 0
|
||||
directory, is available in $FOAM_ETC/caseDicts/solvers/scalarTransport.
|
||||
|
||||
\*---------------------------------------------------------------------------*/
|
||||
|
||||
#includeEtc "caseDicts/postProcessing/solvers/scalarTransport/scalarTransport.cfg"
|
||||
|
||||
field tracer;
|
||||
|
||||
fvOptions
|
||||
{
|
||||
volumeFraction
|
||||
{
|
||||
type volumeFractionSource;
|
||||
phase solid;
|
||||
phi phi;
|
||||
rho rho;
|
||||
U U;
|
||||
fields (tracer);
|
||||
}
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volVectorField;
|
||||
location "0";
|
||||
object U;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 1 -1 0 0 0 0];
|
||||
|
||||
internalField uniform (10 0 0);
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type fixedValue;
|
||||
value $internalField;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type noSlip;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object p;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 2 -2 0 0 0 0];
|
||||
|
||||
internalField uniform 0;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type fixedValue;
|
||||
value $internalField;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,44 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class volScalarField;
|
||||
location "0";
|
||||
object tracer;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
dimensions [0 0 0 0 0 0 0];
|
||||
|
||||
internalField uniform 0;
|
||||
|
||||
boundaryField
|
||||
{
|
||||
inlet
|
||||
{
|
||||
type fixedValue;
|
||||
value uniform 1;
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
walls
|
||||
{
|
||||
type zeroGradient;
|
||||
}
|
||||
frontAndBack
|
||||
{
|
||||
type empty;
|
||||
}
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
7
tutorials/incompressible/pimpleFoam/laminar/blockedChannel/Allclean
Executable file
7
tutorials/incompressible/pimpleFoam/laminar/blockedChannel/Allclean
Executable file
@ -0,0 +1,7 @@
|
||||
#!/bin/sh
|
||||
|
||||
cd ${0%/*} || exit 1
|
||||
|
||||
. $WM_PROJECT_DIR/bin/tools/CleanFunctions
|
||||
|
||||
cleanCase && rm -f constant/alpha.solid
|
||||
9
tutorials/incompressible/pimpleFoam/laminar/blockedChannel/Allrun
Executable file
9
tutorials/incompressible/pimpleFoam/laminar/blockedChannel/Allrun
Executable file
@ -0,0 +1,9 @@
|
||||
#!/bin/sh
|
||||
|
||||
cd ${0%/*} || exit 1
|
||||
|
||||
. $WM_PROJECT_DIR/bin/tools/RunFunctions
|
||||
|
||||
runApplication blockMesh
|
||||
runApplication postProcess -func generateAlphaSolid
|
||||
runApplication $(getApplication)
|
||||
@ -0,0 +1,22 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object transportProperties;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
transportModel Newtonian;
|
||||
|
||||
nu [0 2 -1 0 0 0 0] 1e-05;
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,20 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object turbulenceProperties;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
simulationType laminar;
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,111 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
object blockMeshDict;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
convertToMeters 0.001;
|
||||
|
||||
vertices
|
||||
(
|
||||
(0 -16 -1) (256 -16 -1)
|
||||
(0 16 -1) (256 16 -1)
|
||||
(0 -16 1) (256 -16 1)
|
||||
(0 16 1) (256 16 1)
|
||||
|
||||
(0 -52 -1) ( 32 -52 -1) (64 -44 -1) (128 -44 -1) (224 -52 -1) (256 -52 -1)
|
||||
(0 -20 -1) ( 32 -20 -1) (64 -28 -1) (128 -28 -1) (224 -20 -1) (256 -20 -1)
|
||||
(0 -52 1) ( 32 -52 1) (64 -44 1) (128 -44 1) (224 -52 1) (256 -52 1)
|
||||
(0 -20 1) ( 32 -20 1) (64 -28 1) (128 -28 1) (224 -20 1) (256 -20 1)
|
||||
|
||||
(0 -88 -1) (256 -88 -1)
|
||||
(0 -56 -1) (256 -56 -1)
|
||||
(0 -88 1) (256 -88 1)
|
||||
(0 -56 1) (256 -56 1)
|
||||
);
|
||||
|
||||
blocks
|
||||
(
|
||||
hex (0 1 3 2 4 5 7 6) (256 32 1) simpleGrading (1 1 1)
|
||||
|
||||
hex (8 9 15 14 20 21 27 26) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (9 10 16 15 21 22 28 27) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (10 11 17 16 22 23 29 28) (32 32 1) simpleGrading (1 1 1)
|
||||
hex (11 12 18 17 23 24 30 29) (96 32 1) simpleGrading (1 1 1)
|
||||
hex (12 13 19 18 24 25 31 30) (64 32 1) simpleGrading (1 1 1)
|
||||
|
||||
hex (32 33 35 34 36 37 39 38) (256 32 1) simpleGrading (1 1 1)
|
||||
);
|
||||
|
||||
edges
|
||||
(
|
||||
);
|
||||
|
||||
defaultPatch
|
||||
{
|
||||
name frontAndBack;
|
||||
type empty;
|
||||
}
|
||||
|
||||
boundary
|
||||
(
|
||||
inlet
|
||||
{
|
||||
type patch;
|
||||
faces
|
||||
(
|
||||
(0 2 6 4)
|
||||
|
||||
(8 14 26 20)
|
||||
|
||||
(32 34 38 36)
|
||||
);
|
||||
}
|
||||
outlet
|
||||
{
|
||||
type patch;
|
||||
faces
|
||||
(
|
||||
(1 3 7 5)
|
||||
|
||||
(13 19 31 25)
|
||||
|
||||
(33 35 39 37)
|
||||
);
|
||||
}
|
||||
walls
|
||||
{
|
||||
type wall;
|
||||
faces
|
||||
(
|
||||
(0 1 5 4)
|
||||
(2 3 7 6)
|
||||
|
||||
(8 9 21 20)
|
||||
(9 10 22 21)
|
||||
(10 11 23 22)
|
||||
(11 12 24 23)
|
||||
(12 13 25 24)
|
||||
(14 15 27 26)
|
||||
(15 16 28 27)
|
||||
(16 17 29 28)
|
||||
(17 18 30 29)
|
||||
(18 19 31 30)
|
||||
|
||||
(32 33 37 36)
|
||||
(34 35 39 38)
|
||||
);
|
||||
}
|
||||
);
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,57 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object controlDict;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
application pimpleFoam;
|
||||
|
||||
startFrom latestTime;
|
||||
|
||||
startTime 0;
|
||||
|
||||
stopAt endTime;
|
||||
|
||||
endTime 0.03;
|
||||
|
||||
deltaT 0.0001;
|
||||
|
||||
writeControl adjustableRunTime;
|
||||
|
||||
writeInterval 0.001;
|
||||
|
||||
purgeWrite 0;
|
||||
|
||||
writeFormat ascii;
|
||||
|
||||
writePrecision 6;
|
||||
|
||||
writeCompression off;
|
||||
|
||||
timeFormat general;
|
||||
|
||||
timePrecision 6;
|
||||
|
||||
runTimeModifiable yes;
|
||||
|
||||
adjustTimeStep yes;
|
||||
|
||||
maxCo 5;
|
||||
|
||||
functions
|
||||
{
|
||||
#includeFunc scalarTransport
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,27 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "constant";
|
||||
object fvOptions;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
volumeFraction
|
||||
{
|
||||
type volumeFractionSource;
|
||||
phase solid;
|
||||
phi phi;
|
||||
U U;
|
||||
fields (U);
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,54 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object fvSchemes;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
ddtSchemes
|
||||
{
|
||||
default Euler;
|
||||
}
|
||||
|
||||
gradSchemes
|
||||
{
|
||||
default Gauss linear;
|
||||
limited cellLimited Gauss linear 1;
|
||||
}
|
||||
|
||||
divSchemes
|
||||
{
|
||||
default none;
|
||||
|
||||
div(phi,U) Gauss linearUpwind limited;
|
||||
div(phi,tracer) Gauss linearUpwind limited;
|
||||
div((nuEff*dev2(T(grad(U))))) Gauss linear;
|
||||
}
|
||||
|
||||
laplacianSchemes
|
||||
{
|
||||
default Gauss linear corrected;
|
||||
}
|
||||
|
||||
interpolationSchemes
|
||||
{
|
||||
default linear;
|
||||
}
|
||||
|
||||
snGradSchemes
|
||||
{
|
||||
default corrected;
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,56 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
FoamFile
|
||||
{
|
||||
version 2.0;
|
||||
format ascii;
|
||||
class dictionary;
|
||||
location "system";
|
||||
object fvSolution;
|
||||
}
|
||||
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
|
||||
|
||||
solvers
|
||||
{
|
||||
p
|
||||
{
|
||||
solver GAMG;
|
||||
smoother DICGaussSeidel;
|
||||
tolerance 1e-7;
|
||||
relTol 0.01;
|
||||
}
|
||||
|
||||
pFinal
|
||||
{
|
||||
$p;
|
||||
relTol 0;
|
||||
}
|
||||
|
||||
"(U|tracer)"
|
||||
{
|
||||
solver PBiCGStab;
|
||||
preconditioner DILU;
|
||||
tolerance 1e-05;
|
||||
relTol 0.1;
|
||||
}
|
||||
|
||||
"(U|tracer)Final"
|
||||
{
|
||||
$U;
|
||||
relTol 0;
|
||||
}
|
||||
}
|
||||
|
||||
PIMPLE
|
||||
{
|
||||
nNonOrthogonalCorrectors 0;
|
||||
nCorrectors 2;
|
||||
}
|
||||
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,49 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
\*---------------------------------------------------------------------------*/
|
||||
|
||||
type coded;
|
||||
libs ("libutilityFunctionObjects.so");
|
||||
|
||||
name generateAlphaSolid;
|
||||
|
||||
codeWrite
|
||||
#{
|
||||
const dimensionedVector dx(dimless/dimLength, vector(1, 0, 0));
|
||||
const dimensionedVector dy(dimless/dimLength, vector(0, 1, 0));
|
||||
|
||||
const volScalarField x(mesh().C() & dx), y(mesh().C() & dy);
|
||||
|
||||
const scalar x0 = 0.032, x1 = 0.064, x2 = 0.128, x3 = 0.224;
|
||||
const scalar y0 = -0.088, y1 = -0.056;
|
||||
|
||||
volScalarField alpha
|
||||
(
|
||||
IOobject
|
||||
(
|
||||
IOobject::groupName("alpha", "solid"),
|
||||
mesh().time().constant(),
|
||||
mesh()
|
||||
),
|
||||
mesh(),
|
||||
dimless,
|
||||
zeroGradientFvPatchScalarField::typeName
|
||||
);
|
||||
|
||||
alpha =
|
||||
0.5
|
||||
*(
|
||||
pos(x - x0)*pos(x1 - x)*(x - x0)/(x1 - x0)
|
||||
+ pos(x - x1)*pos(x2 - x)
|
||||
+ pos(x - x2)*pos(x3 - x)*(x3 - x)/(x3 - x2)
|
||||
)
|
||||
*pos(y - y0)*pos(y1 - y);
|
||||
|
||||
alpha.write();
|
||||
#};
|
||||
|
||||
// ************************************************************************* //
|
||||
@ -0,0 +1,33 @@
|
||||
/*--------------------------------*- C++ -*----------------------------------*\
|
||||
========= |
|
||||
\\ / F ield | OpenFOAM: The Open Source CFD Toolbox
|
||||
\\ / O peration | Website: https://openfoam.org
|
||||
\\ / A nd | Version: dev
|
||||
\\/ M anipulation |
|
||||
-------------------------------------------------------------------------------
|
||||
Description
|
||||
Solves a transport equation for a scalar field.
|
||||
|
||||
The name of the scalar field is specified in this file. A sample scalar
|
||||
field file, that must be initialised for the case, typically in the 0
|
||||
directory, is available in $FOAM_ETC/caseDicts/solvers/scalarTransport.
|
||||
|
||||
\*---------------------------------------------------------------------------*/
|
||||
|
||||
#includeEtc "caseDicts/postProcessing/solvers/scalarTransport/scalarTransport.cfg"
|
||||
|
||||
field tracer;
|
||||
|
||||
fvOptions
|
||||
{
|
||||
volumeFraction
|
||||
{
|
||||
type volumeFractionSource;
|
||||
phase solid;
|
||||
phi phi;
|
||||
U U;
|
||||
fields (tracer);
|
||||
}
|
||||
}
|
||||
|
||||
// ************************************************************************* //
|
||||
Reference in New Issue
Block a user