zhyang-dev/OpenFOAM-5.x
1
0
Fork 0
Code Issues Pull Requests Actions Packages Projects Releases Wiki Activity

sloshingCylinder tutorial: sloshing in cylinder under zero gravity

Browse Source 
Demonstrates meshing a cylinder with hemispehrical ends using snappyHexMesh with
a polar background mesh that uses the point and edge projection feature of blockMesh.
The case prescribes a multiMotion on the cylinder, combining an oscillatingLinearMotion
and transverse rotatingMotion.
This commit is contained in:
Chris Greenshields
2017-03-24 14:43:53 +00:00
parent 1cf43717ab
commit 244109d2f8
17 changed files with 49188 additions and 0 deletions
Download Patch File Download Diff File Expand all files Collapse all files

32
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/0/U Normal file
View File

@ -0,0 +1,32 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volVectorField;
object U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -1 0 0 0 0];
internalField uniform (0 0 0);
boundaryField
{
wall
{
type movingWallVelocity;
value uniform (0 0 0);
}
#includeEtc "caseDicts/setConstraintTypes"
}
// ************************************************************************* //

31
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/0/alpha.water.orig Normal file
View File

@ -0,0 +1,31 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object alpha.water;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 0 0 0 0 0 0];
internalField uniform 0;
boundaryField
{
wall
{
type zeroGradient;
}
#includeEtc "caseDicts/setConstraintTypes"
}
// ************************************************************************* //

31
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/0/p_rgh Normal file
View File

@ -0,0 +1,31 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object p_rgh;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [1 -1 -2 0 0 0 0];
internalField uniform 0;
boundaryField
{
wall
{
type fixedFluxPressure;
}
#includeEtc "caseDicts/setConstraintTypes"
}
// ************************************************************************* //

7
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/Allclean Executable file
View File

@ -0,0 +1,7 @@
#!/bin/sh
cd ${0%/*} || exit 1 # Run from this directory
foamCleanTutorials cases
rm -rf 0/alpha.water 0/alpha.water.gz probes wallPressure pRefProbe
#------------------------------------------------------------------------------

13
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/Allrun Executable file
View File

@ -0,0 +1,13 @@
#!/bin/sh
cd ${0%/*} || exit 1 # Run from this directory
# Source tutorial run functions
. $WM_PROJECT_DIR/bin/tools/RunFunctions
runApplication blockMesh
runApplication snappyHexMesh -overwrite
cp 0/alpha.water.orig 0/alpha.water
runApplication setFields
runApplication `getApplication`
#------------------------------------------------------------------------------

52
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/constant/dynamicMeshDict Normal file
View File

@ -0,0 +1,52 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object dynamicMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dynamicFvMesh dynamicMotionSolverFvMesh;
solver solidBody;
solidBodyCoeffs
{
solidBodyMotionFunction multiMotion;
multiMotionCoeffs
{
oscillation
{
solidBodyMotionFunction oscillatingLinearMotion;
oscillatingLinearMotionCoeffs
{
amplitude (0.1 0 0);
omega 18.8945578;
}
}
rotation
{
solidBodyMotionFunction rotatingMotion;
rotatingMotionCoeffs
{
origin (0 0.02 0);
axis (0 0 1);
omega 18.8945578;
}
}
}
}
// ************************************************************************* //

22
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/constant/g Normal file
View File

@ -0,0 +1,22 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class uniformDimensionedVectorField;
location "constant";
object g;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -2 0 0 0 0];
value (0 0 0);
// ************************************************************************* //

36
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/constant/transportProperties Normal file
View File

@ -0,0 +1,36 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object transportProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
phases (water air);
water
{
transportModel Newtonian;
nu [0 2 -1 0 0 0 0] 1e-06;
rho [1 -3 0 0 0 0 0] 998.2;
}
air
{
transportModel Newtonian;
nu [0 2 -1 0 0 0 0] 1.48e-05;
rho [1 -3 0 0 0 0 0] 1;
}
sigma [1 0 -2 0 0 0 0] 0.07;
// ************************************************************************* //

48510
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/constant/triSurface/sloshingCylinder.obj Normal file
View File

File diff suppressed because it is too large Load Diff

21
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/constant/turbulenceProperties Normal file
View File

@ -0,0 +1,21 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object turbulenceProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
simulationType laminar;
// ************************************************************************* //

95
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/blockMeshDict Normal file
View File

@ -0,0 +1,95 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object blockMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
radius 0.081;
radiusNeg -0.081;
box 0.025;
boxNeg -0.025;
zMax 0.150;
zMin -0.150;
nR 7;
nZ 20;
verbose no;
geometry
{
cylinder
{
type searchableCylinder;
point1 (0 0 -1);
point2 (0 0 1);
radius $radius;
}
}
scale 1;
vertices
(
// Inner
($boxNeg $boxNeg $zMin)
($box $boxNeg $zMin)
($boxNeg $box $zMin)
($box $box $zMin)
// Outer block points
project ($radiusNeg $radiusNeg $zMin) (cylinder)
project ($radius $radiusNeg $zMin) (cylinder)
project ($radiusNeg $radius $zMin) (cylinder)
project ($radius $radius $zMin) (cylinder)
// Inner
($boxNeg $boxNeg $zMax)
($box $boxNeg $zMax)
($boxNeg $box $zMax)
($box $box $zMax)
// Outer block points
project ($radiusNeg $radiusNeg $zMax) (cylinder)
project ($radius $radiusNeg $zMax) (cylinder)
project ($radiusNeg $radius $zMax) (cylinder)
project ($radius $radius $zMax) (cylinder)
);
blocks
(
hex ( 4 5 1 0 12 13 9 8) ($nR $nR $nZ) simpleGrading (1 1 1)
hex ( 4 0 2 6 12 8 10 14) ($nR $nR $nZ) simpleGrading (1 1 1)
hex ( 1 5 7 3 9 13 15 11) ($nR $nR $nZ) simpleGrading (1 1 1)
hex ( 2 3 7 6 10 11 15 14) ($nR $nR $nZ) simpleGrading (1 1 1)
hex ( 0 1 3 2 8 9 11 10) ($nR $nR $nZ) simpleGrading (1 1 1)
);
edges
(
project 4 5 (cylinder)
project 7 5 (cylinder)
project 6 7 (cylinder)
project 4 6 (cylinder)
project 12 13 (cylinder)
project 13 15 (cylinder)
project 12 14 (cylinder)
project 14 15 (cylinder)
);
boundary
(
);
// ************************************************************************* //

60
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/controlDict Normal file
View File

@ -0,0 +1,60 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object controlDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
application interDyMFoam;
startFrom latestTime;
startTime 0;
stopAt endTime;
endTime 0.5;
deltaT 0.001;
writeControl adjustableRunTime;
writeInterval 0.02;
purgeWrite 0;
writeFormat ascii;
writePrecision 6;
writeCompression yes;
timeFormat general;
timePrecision 6;
runTimeModifiable yes;
adjustTimeStep yes;
maxCo 2;
maxAlphaCo 2;
maxDeltaT 1;
functions
{
}
// ************************************************************************* //

51
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/fvSchemes Normal file
View File

@ -0,0 +1,51 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSchemes;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
ddtSchemes
{
default Euler;
}
gradSchemes
{
default Gauss linear;
}
divSchemes
{
div(rhoPhi,U) Gauss vanLeerV;
div(phi,alpha) Gauss vanLeer;
div(phirb,alpha) Gauss vanLeer;
div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
}
laplacianSchemes
{
default Gauss linear corrected;
}
interpolationSchemes
{
default linear;
}
snGradSchemes
{
default corrected;
}
// ************************************************************************* //

89
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/fvSolution Normal file
View File

@ -0,0 +1,89 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSolution;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
solvers
{
"alpha.water.*"
{
nAlphaCorr 2;
nAlphaSubCycles 1;
cAlpha 1;
MULESCorr yes;
nLimiterIter 8;
solver smoothSolver;
smoother symGaussSeidel;
tolerance 1e-8;
relTol 0;
}
"pcorr.*"
{
solver PCG;
preconditioner DIC;
tolerance 1e-10;
relTol 0;
maxIter 100;
}
p_rgh
{
solver GAMG;
smoother DIC;
tolerance 1e-05;
relTol 0.01;
}
p_rghFinal
{
$p_rgh;
relTol 0;
maxIter 20;
}
U
{
solver smoothSolver;
smoother GaussSeidel;
tolerance 1e-06;
relTol 0;
nSweeps 1;
}
}
PIMPLE
{
momentumPredictor no;
nCorrectors 2;
nNonOrthogonalCorrectors 1;
correctPhi no;
pRefPoint (0 0 0);
pRefValue 1e5;
}
relaxationFactors
{
equations
{
"U.*" 1;
}
}
// ************************************************************************* //

19
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/meshQualityDict Normal file
View File

@ -0,0 +1,19 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object meshQualityDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
#includeEtc "caseDicts/mesh/generation/meshQualityDict.cfg"
// ************************************************************************* //

36
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/setFieldsDict Normal file
View File

@ -0,0 +1,36 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object setFieldsDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
defaultFieldValues
(
volScalarFieldValue alpha.water 0
);
regions
(
boxToCell
{
box (-1 -1 -1) (1 1 -0.06);
fieldValues
(
volScalarFieldValue alpha.water 1
);
}
);
// ************************************************************************* //

83
tutorials/multiphase/interDyMFoam/laminar/sloshingCylinder/system/snappyHexMeshDict Normal file
View File

@ -0,0 +1,83 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object snappyHexMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
#includeEtc "caseDicts/mesh/generation/snappyHexMeshDict.cfg"
castellatedMesh on;
snap on;
addLayers off;
geometry
{
sloshingCylinder.obj
{
type closedTriSurfaceMesh;
name sloshingCylinder;
}
};
castellatedMeshControls
{
features
(
);
refinementSurfaces
{
sloshingCylinder
{
level (1 1);
patchInfo { type wall; }
}
}
refinementRegions
{
sloshingCylinder
{
mode inside;
levels ((1E15 1));
}
}
locationInMesh (1e-5 1e-5 1e-5);
}
snapControls
{
explicitFeatureSnap false;
implicitFeatureSnap false;
}
addLayersControls
{
layers
{
}
relativeSizes true;
expansionRatio 1.2;
finalLayerThickness 0.5;
minThickness 1e-3;
}
writeFlags
(
);
mergeTolerance 1e-6;
// ************************************************************************* //