diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/0/U b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/U
new file mode 100644
index 0000000000..8b7d69447a
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/U
@@ -0,0 +1,46 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volVectorField;
+    object      U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+Uinlet          (10 0 0);
+
+dimensions      [0 1 -1 0 0 0 0];
+
+internalField   uniform (0 0 0);
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           uniform $Uinlet;
+    }
+
+    outlet
+    {
+        type            pressureInletOutletVelocity;
+        value           uniform (0 0 0);
+    }
+
+    wall
+    {
+        type            fixedValue;
+        value           uniform (0 0 0);
+    }
+
+    #includeEtc "caseDicts/setConstraintTypes"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/0/epsilon b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/epsilon
new file mode 100644
index 0000000000..0d85dabb8b
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/epsilon
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    object      epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+epsilonInlet  0.03; // Cmu^0.75 * k^1.5 / L ; L =10
+
+dimensions      [0 2 -3 0 0 0 0];
+
+internalField   uniform $epsilonInlet;
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           uniform $epsilonInlet;
+    }
+
+    outlet
+    {
+        type            inletOutlet;
+        inletValue      uniform $epsilonInlet;
+        value           uniform $epsilonInlet;
+    }
+
+    wall
+    {
+        type            epsilonWallFunction;
+        value           uniform $epsilonInlet;
+    }
+
+    #includeEtc "caseDicts/setConstraintTypes"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/0/k b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/k
new file mode 100644
index 0000000000..791667e164
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/k
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    object      k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+kInlet          1.5;   // approx k = 1.5*(I*U)^2 ; I = 0.1
+
+dimensions      [0 2 -2 0 0 0 0];
+
+internalField   uniform $kInlet;
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           uniform $kInlet;
+    }
+
+    outlet
+    {
+        type            inletOutlet;
+        inletValue      uniform $kInlet;
+        value           uniform $kInlet;
+    }
+
+    wall
+    {
+        type            kqRWallFunction;
+        value           uniform $kInlet;
+    }
+
+    #includeEtc "caseDicts/setConstraintTypes"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/0/nut b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/nut
new file mode 100644
index 0000000000..54a56f319f
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/nut
@@ -0,0 +1,44 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    object      nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -1 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    inlet
+    {
+        type            calculated;
+        value           uniform 0;
+    }
+
+    outlet
+    {
+        type            calculated;
+        value           uniform 0;
+    }
+
+    wall
+    {
+        type            nutkWallFunction;
+        value           uniform 0;
+    }
+
+    #includeEtc "caseDicts/setConstraintTypes"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/0/p b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/p
new file mode 100644
index 0000000000..3bca06ea5a
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/0/p
@@ -0,0 +1,44 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    object      p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -2 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    inlet
+    {
+        type            zeroGradient;
+    }
+
+    outlet
+    {
+        type            totalPressure;
+        p0              uniform 0;
+        gamma           1.4;
+        value           uniform 0;
+    }
+
+    wall
+    {
+        type            zeroGradient;
+    }
+
+    #includeEtc "caseDicts/setConstraintTypes"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/Allclean b/tutorials/incompressible/simpleFoam/windAroundBuildings/Allclean
new file mode 100755
index 0000000000..3427112d73
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/Allclean
@@ -0,0 +1,13 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial clean functions
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+
+rm -rf constant/extendedFeatureEdgeMesh > /dev/null 2>&1
+rm -f constant/triSurface/buildings.eMesh > /dev/null 2>&1
+rm -f constant/polyMesh/boundary > /dev/null 2>&1
+
+# ----------------------------------------------------------------- end-of-file
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/Allrun b/tutorials/incompressible/simpleFoam/windAroundBuildings/Allrun
new file mode 100755
index 0000000000..1e6e2f7318
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/Allrun
@@ -0,0 +1,14 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+runApplication surfaceFeatureExtract
+
+runApplication blockMesh
+runApplication snappyHexMesh -overwrite
+
+runApplication $(getApplication)
+
+# ----------------------------------------------------------------- end-of-file
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/transportProperties b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/transportProperties
new file mode 100644
index 0000000000..5911012330
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/transportProperties
@@ -0,0 +1,21 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel  Newtonian;
+
+nu              nu [ 0 2 -1 0 0 0 0 ] 1.5e-05;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/triSurface/buildings.obj.gz b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/triSurface/buildings.obj.gz
new file mode 100644
index 0000000000..5a83ee5faf
Binary files /dev/null and b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/triSurface/buildings.obj.gz differ
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/turbulenceProperties b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/turbulenceProperties
new file mode 100644
index 0000000000..c4d5b2e351
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/constant/turbulenceProperties
@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      RASProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+    RASModel        kEpsilon;
+
+    turbulence      on;
+
+    printCoeffs     on;
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/blockMeshDict b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/blockMeshDict
new file mode 100644
index 0000000000..91ae59260b
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/blockMeshDict
@@ -0,0 +1,106 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+backgroundMesh
+{
+    xMin   -20; // L = 350
+    xMax   330;
+    yMin   -50; // L = 280
+    yMax   230;
+    zMin     0;
+    zMax   140;
+    xCells  25;
+    yCells  20;
+    zCells  10;
+}
+
+convertToMeters 1;
+
+vertices
+(
+    ($:backgroundMesh.xMin $:backgroundMesh.yMin $:backgroundMesh.zMin)
+    ($:backgroundMesh.xMax $:backgroundMesh.yMin $:backgroundMesh.zMin)
+    ($:backgroundMesh.xMax $:backgroundMesh.yMax $:backgroundMesh.zMin)
+    ($:backgroundMesh.xMin $:backgroundMesh.yMax $:backgroundMesh.zMin)
+
+    ($:backgroundMesh.xMin $:backgroundMesh.yMin $:backgroundMesh.zMax)
+    ($:backgroundMesh.xMax $:backgroundMesh.yMin $:backgroundMesh.zMax)
+    ($:backgroundMesh.xMax $:backgroundMesh.yMax $:backgroundMesh.zMax)
+    ($:backgroundMesh.xMin $:backgroundMesh.yMax $:backgroundMesh.zMax)
+);
+
+blocks
+(
+    hex (0 1 2 3 4 5 6 7)
+    (
+        $:backgroundMesh.xCells
+        $:backgroundMesh.yCells
+        $:backgroundMesh.zCells
+    )
+    simpleGrading (1 1 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+    inlet
+    {
+        type patch;
+        faces
+        (
+            (0 3 7 4)
+        );
+    }
+
+    outlet
+    {
+        type patch;
+        faces
+        (
+            (1 5 6 2)
+        );
+    }
+
+    ground
+    {
+        type wall;
+        faces
+        (
+            (0 1 2 3)
+        );
+    }
+
+    frontAndBack
+    {
+        type symmetry;
+        faces
+        (
+            (0 4 5 1)
+            (3 2 6 7)
+            (4 7 6 5)
+        );
+    }
+
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/controlDict b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/controlDict
new file mode 100644
index 0000000000..e34ff9f922
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/controlDict
@@ -0,0 +1,55 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application     simpleFoam;
+
+startFrom       latestTime;
+
+startTime       0;
+
+stopAt          endTime;
+
+endTime         400;
+
+deltaT          1;
+
+writeControl    timeStep;
+
+writeInterval   50;
+
+purgeWrite      0;
+
+writeFormat     ascii;
+
+writePrecision  6;
+
+writeCompression off;
+
+timeFormat      general;
+
+timePrecision   6;
+
+runTimeModifiable true;
+
+// adjustTimeStep  yes;
+
+// maxCo           1;
+
+functions
+{
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSchemes b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSchemes
new file mode 100644
index 0000000000..3a3dd154a4
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSchemes
@@ -0,0 +1,71 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+    default         steadyState;
+}
+
+gradSchemes
+{
+    default         Gauss linear;
+
+    limited         cellLimited Gauss linear 1;
+    grad(U)         $limited;
+    grad(k)         $limited;
+    grad(epsilon)     $limited;
+}
+
+divSchemes
+{
+    default         none;
+
+    div(phi,U)      bounded Gauss linearUpwind limited;
+
+    turbulence      bounded Gauss limitedLinear 1;
+    div(phi,k)      $turbulence;
+    div(phi,epsilon) $turbulence;
+
+    div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+    default         Gauss linear corrected;
+}
+
+interpolationSchemes
+{
+    default         linear;
+}
+
+snGradSchemes
+{
+    default         corrected;
+}
+
+fluxRequired
+{
+    default         no;
+    p               ;
+}
+
+wallDist
+{
+    method meshWave;
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSolution b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSolution
new file mode 100644
index 0000000000..bdb34dd0f4
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/fvSolution
@@ -0,0 +1,72 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+    p
+    {
+        solver          GAMG;
+        smoother        GaussSeidel;
+        cacheAgglomeration on;
+        agglomerator    faceAreaPair;
+        nCellsInCoarsestLevel 10;
+        mergeLevels     1;
+        tolerance       1e-6;
+        relTol          0.1;
+    }
+
+    "(U|k|omega|epsilon)"
+    {
+        solver          smoothSolver;
+        smoother        symGaussSeidel;
+        tolerance       1e-6;
+        relTol          0.1;
+    }
+}
+
+SIMPLE
+{
+    residualControl
+    {
+        p               1e-4;
+        U               1e-4;
+        "(k|omega|epsilon)" 1e-4;
+    }
+    nNonOrthogonalCorrectors 0;
+    pRefCell        0;
+    pRefValue       0;
+
+}
+
+potentialFlow
+{
+    nNonOrthogonalCorrectors 10;
+}
+
+relaxationFactors
+{
+    fields
+    {
+        p               0.3;
+    }
+    equations
+    {
+        U               0.7;
+        "(k|omega|epsilon).*" 0.7;
+    }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/meshQualityDict b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/meshQualityDict
new file mode 100644
index 0000000000..c38396d710
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/meshQualityDict
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      meshQualityDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+#includeEtc "caseDicts/mesh/generation/meshQualityDict.cfg"
+
+//- minFaceWeight (0 -> 0.5)
+//minFaceWeight 0.02;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/snappyHexMeshDict b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/snappyHexMeshDict
new file mode 100644
index 0000000000..fed73f13c1
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/snappyHexMeshDict
@@ -0,0 +1,102 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      snappyHexMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+#includeEtc "caseDicts/mesh/generation/snappyHexMeshDict.cfg"
+
+castellatedMesh on;
+snap            on;
+addLayers       off;
+
+geometry
+{
+    buildings.obj
+    {
+        type triSurfaceMesh;
+        name buildings;
+    }
+
+    refinementBox
+    {
+        type searchableBox;
+        min  (  0   0   0);
+        max  (250 180  90);
+    }
+};
+
+castellatedMeshControls
+{
+    features
+    (
+      { file  "buildings.eMesh"; level 1; }
+    );
+
+    refinementSurfaces
+    {
+        buildings
+        {
+            level (3 3);
+            patchInfo { type wall; }
+        }
+    }
+
+    refinementRegions
+    {
+        refinementBox
+        {
+            mode inside;
+            levels ((1E15 2));
+        }
+    }
+
+    locationInMesh (1 1 1);
+}
+
+snapControls
+{
+    explicitFeatureSnap    true;
+    implicitFeatureSnap    false;
+}
+
+addLayersControls
+{
+    layers
+    {
+        "CAD.*"
+        {
+            nSurfaceLayers 2;
+        }
+    }
+
+    relativeSizes       true;
+    expansionRatio      1.2;
+    finalLayerThickness 0.5;
+    minThickness        1e-3;
+}
+
+meshQualityControls
+{
+}
+
+writeFlags
+(
+    scalarLevels
+    layerSets
+    layerFields
+);
+
+mergeTolerance 1e-6;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/windAroundBuildings/system/surfaceFeatureExtractDict b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/surfaceFeatureExtractDict
new file mode 100644
index 0000000000..10a7645af2
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/windAroundBuildings/system/surfaceFeatureExtractDict
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      surfaceFeatureExtractDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+buildings.obj
+{
+    #includeEtc "caseDicts/surface/surfaceFeatureExtractDict.cfg"
+}
+
+// ************************************************************************* //