Merge branch 'ACMI'

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/0.org/U

@@ -0,0 +1,67 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volVectorField;
+    location    "0";
+    object      U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 1 -1 0 0 0 0];
+
+internalField   uniform (0 0 0);
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           uniform (1 0 0);
+    }
+    outlet
+    {
+        type            pressureInletOutletVelocity;
+        value           uniform (0 0 0);
+    }
+    walls
+    {
+//        type            fixedValue;
+        type            movingWallVelocity;
+        value           uniform (0 0 0);
+    }
+    defaultFaces
+    {
+        type            empty;
+    }
+    ACMI1_blockage
+    {
+        type            fixedValue;
+        value           uniform (0 0 0);
+    }
+    ACMI1_couple
+    {
+        type            cyclicACMI;
+        value           uniform (0 0 0);
+    }
+    ACMI2_blockage
+    {
+        type            fixedValue;
+        value           uniform (0 0 0);
+    }
+    ACMI2_couple
+    {
+        type            cyclicACMI;
+        value           uniform (0 0 0);
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/0.org/epsilon

@@ -0,0 +1,67 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -3 0 0 0 0];
+
+internalField   uniform 1.8e-3;
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+    outlet
+    {
+        type            inletOutlet;
+        inletValue      $internalField;
+        value           $internalField;
+    }
+    walls
+    {
+        type            epsilonWallFunction;
+        value           $internalField;
+    }
+    defaultFaces
+    {
+        type            empty;
+    }
+    ACMI1_blockage
+    {
+        type            epsilonWallFunction;
+        value           $internalField;
+    }
+    ACMI1_couple
+    {
+        type            cyclicACMI;
+        value           $internalField;
+    }
+    ACMI2_blockage
+    {
+        type            epsilonWallFunction;
+        value           $internalField;
+    }
+    ACMI2_couple
+    {
+        type            cyclicACMI;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/0.org/k

@@ -0,0 +1,67 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -2 0 0 0 0];
+
+internalField   uniform 3.75e-3;
+
+boundaryField
+{
+    inlet
+    {
+        type            fixedValue;
+        value           $internalField;
+    }
+    outlet
+    {
+        type            inletOutlet;
+        inletValue      $internalField;
+        value           $internalField;
+    }
+    walls
+    {
+        type            kqRWallFunction;
+        value           $internalField;
+    }
+    defaultFaces
+    {
+        type            empty;
+    }
+    ACMI1_blockage
+    {
+        type            kqRWallFunction;
+        value           $internalField;
+    }
+    ACMI1_couple
+    {
+        type            cyclicACMI;
+        value           $internalField;
+    }
+    ACMI2_blockage
+    {
+        type            kqRWallFunction;
+        value           $internalField;
+    }
+    ACMI2_couple
+    {
+        type            cyclicACMI;
+        value           $internalField;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/0.org/p

@@ -0,0 +1,70 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       volScalarField;
+    location    "0";
+    object      p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions      [0 2 -2 0 0 0 0];
+
+internalField   uniform 0;
+
+boundaryField
+{
+    inlet
+    {
+        type            zeroGradient;
+    }
+    outlet
+    {
+        type            fixedValue;
+        value           uniform 0;
+    }
+    walls
+    {
+        type            zeroGradient;
+    }
+    couple1
+    {
+        type            zeroGradient;
+    }
+    couple2
+    {
+        type            zeroGradient;
+    }
+    defaultFaces
+    {
+        type            empty;
+    }
+    ACMI1_blockage
+    {
+        type            zeroGradient;
+    }
+    ACMI1_couple
+    {
+        type            cyclicACMI;
+        value           uniform 0;
+    }
+    ACMI2_blockage
+    {
+        type            zeroGradient;
+    }
+    ACMI2_couple
+    {
+        type            cyclicACMI;
+        value           uniform 0;
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/Allclean

@@ -0,0 +1,9 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial clean functions
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+
+rm -rf 0

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/Allrun

@@ -0,0 +1,9 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+./Allrun.pre
+
+runApplication $(getApplication)

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/Allrun-parallel

@@ -0,0 +1,13 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+./Allrun.pre
+
+runApplication decomposePar
+
+runParallel $(getApplication) 4
+
+runApplication reconstructPar

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/Allrun.pre

@@ -0,0 +1,17 @@
+#!/bin/sh
+cd ${0%/*} || exit 1    # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+runApplication blockMesh
+
+runApplication topoSet -constant
+
+# split the mesh to generate the ACMI coupled patches
+runApplication createBaffles -overwrite
+
+# remove zero-sized patches
+runApplication createPatch -overwrite
+
+cp -rf 0.org 0

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/README

@@ -0,0 +1,104 @@
+oscillatingInletACMI2D
+
+This tutorial case gives an example of the Arbitrarily Coupled Mesh Interface
+(ACMI) usage.  The mesh is composed of two mesh regions: an inlet channel which
+oscillates in the +/- Y-direction, and a fixed mesh region.
+
+Each ACMI patch requires the specification of a 'non-overlapping' patch.  In
+this example, the non-overlapping patches are described as walls, e.g. taken
+from the constant/polyMesh/boundary file:
+
+    1. First ACMI poatch pair applied to the inlet channel outlet
+
+        ACMI1_blockage
+        {
+            type            wall;
+            nFaces          40;
+            startFace       43680;
+        }
+        ACMI1_couple
+        {
+            type            cyclicACMI;
+            nFaces          40;
+            startFace       43720;
+            matchTolerance  0.0001;
+            transform       noOrdering;
+            neighbourPatch  ACMI2_couple;
+            nonOverlapPatch ACMI1_blockage;
+        }
+
+
+    1. Second ACMI poatch pair applied to the fixed mesh region inlet
+
+        ACMI2_blockage
+        {
+            type            wall;
+            nFaces          96;
+            startFace       43760;
+        }
+        ACMI2_couple
+        {
+            type            cyclicACMI;
+            nFaces          96;
+            startFace       43856;
+            matchTolerance  0.0001;
+            transform       noOrdering;
+            neighbourPatch  ACMI1_couple;
+            nonOverlapPatch ACMI2_blockage;
+        }
+
+
+In the above, the ACMI1_blockage and ACMI1_couple patches occupy the same space,
+with duplicate points, edges and faces.  The ACMI2_blockage and ACMI2_couple
+patches are created similarly.
+
+The duplicate patches are initially created using the createBaffles utility.
+Firstly, the original (non-duplicated) patch faces are collected into zones
+using the topoSet utility.
+
+Each ACMI/no-overlapping patch pair is specified using a master-slave approach.
+However, since we are generating boundary patches (which are always master
+patches) the slave patches are simply defined using 'dummy' entries, e.g.:
+
+    type        faceZone;
+    zoneName    couple1Faces;
+
+    patches
+    {
+        // create blockage patch
+        master
+        {
+            //- Master side patch
+            name            ACMI1_blockage;
+            type            wall;
+        }
+        slave1 // dummy entries only
+        {
+            //- Slave side patch
+            name            ACMI1_blockage;
+            type            wall;
+        }
+
+        // create cyclic ACMI patch
+        master2
+        {
+            //- Master side patch
+            name            ACMI1_couple;
+            type            cyclicACMI;
+            matchTolerance  0.0001;
+            neighbourPatch  ACMI2_couple;
+            nonOverlapPatch ACMI1_blockage;
+            transform       noOrdering;
+        }
+        slave2 // dummy entries only
+        {
+            //- Slave side patch
+            name            ACMI1_couple;
+            type            patch;
+        }
+    }
+
+Boundary conditions must then be applied to all geometric patches in the usual,
+manner, and the cases can be executed in parallel (as shown when running the
+Allrun-parallel script) without any speacial treatment, i.e. the case set-up is
+the same as when operating in serial mode.

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/RASProperties

@@ -0,0 +1,25 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "constant";
+    object      RASProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+RASModel        kEpsilon;
+
+turbulence      on;
+
+printCoeffs     on;
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/dynamicMeshDict

@@ -0,0 +1,36 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "constant";
+    object      dynamicMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dynamicFvMesh   solidBodyMotionFvMesh;
+
+motionSolverLibs ( "libfvMotionSolvers.so" );
+
+solidBodyMotionFvMeshCoeffs
+{
+    cellZone        inletChannel;
+
+    solidBodyMotionFunction  oscillatingLinearMotion;
+
+    oscillatingLinearMotionCoeffs
+    {
+        amplitude       (0 0.5 0);
+        omega           3.14; // rad/s  (.5 rps)
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/polyMesh/blockMeshDict

@@ -0,0 +1,103 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+convertToMeters 1;
+
+vertices
+(
+    (0 0.3 0)
+    (1 0.3 0)
+    (1 0.7 0)
+    (0 0.7 0)
+    (0 0.3 0.1)
+    (1 0.3 0.1)
+    (1 0.7 0.1)
+    (0 0.7 0.1)
+
+    (1 0 0)
+    (3 0 0)
+    (3 1 0)
+    (1 1 0)
+    (1 0 0.1)
+    (3 0 0.1)
+    (3 1 0.1)
+    (1 1 0.1)
+);
+
+blocks
+(
+//    hex (0 1 2 3 4 5 6 7) (20 20 1) simpleGrading (1 1 1)
+//    hex (8 9 10 11 12 13 14 15) (40 48 1) simpleGrading (1 1 1)
+    hex (0 1 2 3 4 5 6 7) (80 40 1) simpleGrading (1 1 1)
+    hex (8 9 10 11 12 13 14 15) (80 96 1) simpleGrading (1 1 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+    inlet
+    {
+        type patch;
+        faces
+        (
+            (0 4 7 3)
+        );
+    }
+    outlet
+    {
+        type patch;
+        faces
+        (
+            (10 14 13 9)
+        );
+    }
+    walls
+    {
+        type wall;
+        faces
+        (
+            (3 7 6 2)
+            (1 5 4 0)
+            (11 15 14 10)
+            (9 13 12 8)
+        );
+    }
+    couple1
+    {
+        type patch;
+        faces
+        (
+            (2 6 5 1)
+        );
+    }
+    couple2
+    {
+        type patch;
+        faces
+        (
+            (8 12 15 11)
+        );
+    }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/polyMesh/boundary

@@ -0,0 +1,81 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev.ACMI                              |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       polyBoundaryMesh;
+    location    "constant/polyMesh";
+    object      boundary;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+8
+(
+    inlet
+    {
+        type            patch;
+        nFaces          40;
+        startFace       21464;
+    }
+    outlet
+    {
+        type            patch;
+        nFaces          96;
+        startFace       21504;
+    }
+    walls
+    {
+        type            wall;
+        nFaces          320;
+        startFace       21600;
+    }
+    defaultFaces
+    {
+        type            empty;
+        inGroups        1(empty);
+        nFaces          21760;
+        startFace       21920;
+    }
+    ACMI1_blockage
+    {
+        type            wall;
+        nFaces          40;
+        startFace       43680;
+    }
+    ACMI1_couple
+    {
+        type            cyclicACMI;
+        inGroups        1(cyclicACMI);
+        nFaces          40;
+        startFace       43720;
+        matchTolerance  0.0001;
+        transform       noOrdering;
+        neighbourPatch  ACMI2_couple;
+        nonOverlapPatch ACMI1_blockage;
+    }
+    ACMI2_blockage
+    {
+        type            wall;
+        nFaces          96;
+        startFace       43760;
+    }
+    ACMI2_couple
+    {
+        type            cyclicACMI;
+        inGroups        1(cyclicACMI);
+        nFaces          96;
+        startFace       43856;
+        matchTolerance  0.0001;
+        transform       noOrdering;
+        neighbourPatch  ACMI1_couple;
+        nonOverlapPatch ACMI2_blockage;
+    }
+)
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/transportProperties

@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "constant";
+    object      transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel  Newtonian;
+
+nu              nu [ 0 2 -1 0 0 0 0 ] 1e-6;
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/constant/turbulenceProperties

@@ -0,0 +1,21 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "constant";
+    object      turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType  RASModel;
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/controlDict

@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "system";
+    object      controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application     pimpleDyMFoam;
+
+startFrom       latestTime;
+
+startTime       0;
+
+stopAt          endTime;
+
+endTime         5;
+
+deltaT          0.005;
+
+writeControl    adjustableRunTime;
+
+writeInterval   0.05;
+
+purgeWrite      0;
+
+writeFormat     ascii;
+
+writePrecision  6;
+
+writeCompression off;
+
+timeFormat      general;
+
+timePrecision   6;
+
+runTimeModifiable true;
+
+adjustTimeStep  true;
+
+maxCo           0.5;
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/createBafflesDict

@@ -0,0 +1,107 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      createBafflesDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+// Whether to convert internal faces only (so leave boundary faces intact).
+// This is only relevant if your face selection type can pick up boundary
+// faces.
+internalFacesOnly false;
+
+
+// Baffles to create.
+baffles
+{
+    ACMI1
+    {
+        //- Use predefined faceZone to select faces and orientation.
+        type        faceZone;
+        zoneName    couple1Faces;
+
+        patches
+        {
+            master
+            {
+                //- Master side patch
+                name            ACMI1_blockage;
+                type            wall;
+            }
+            slave // not used since we're manipulating a boundary patch
+            {
+                //- Slave side patch
+                name            ACMI1_blockage;
+                type            wall;
+            }
+
+            master2
+            {
+                //- Master side patch
+                name            ACMI1_couple;
+                type            cyclicACMI;
+                matchTolerance  0.0001;
+                neighbourPatch  ACMI2_couple;
+                nonOverlapPatch ACMI1_blockage;
+                transform       noOrdering;
+            }
+            slave2 // not used since we're manipulating a boundary patch
+            {
+                //- Slave side patch
+                name            ACMI1_couple;
+                type            patch;
+            }
+        }
+    }
+    ACMI2
+    {
+        //- Use predefined faceZone to select faces and orientation.
+        type        faceZone;
+        zoneName    couple2Faces;
+
+        patches
+        {
+            master
+            {
+                //- Master side patch
+                name            ACMI2_blockage;
+                type            wall;
+            }
+            slave // not used since we're manipulating a boundary patch
+            {
+                //- Slave side patch
+                name            ACMI2_blockage;
+                type            wall;
+            }
+
+            master2
+            {
+                //- Master side patch
+                name            ACMI2_couple;
+                type            cyclicACMI;
+                matchTolerance  0.0001;
+                neighbourPatch  ACMI1_couple;
+                nonOverlapPatch ACMI2_blockage;
+                transform       noOrdering;
+            }
+            slave2 // not used since we're manipulating a boundary patch
+            {
+                //- Slave side patch
+                name            ACMI2_couple;
+                type            patch;
+            }
+        }
+    }
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/createPatchDict

@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      createPatchDict;
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+// This application/dictionary controls:
+// - optional: create new patches from boundary faces (either given as
+//   a set of patches or as a faceSet)
+// - always: order faces on coupled patches such that they are opposite. This
+//   is done for all coupled faces, not just for any patches created.
+// - optional: synchronise points on coupled patches.
+
+// 1. Create cyclic:
+// - specify where the faces should come from
+// - specify the type of cyclic. If a rotational specify the rotationAxis
+//   and centre to make matching easier
+// - always create both halves in one invocation with correct 'neighbourPatch'
+//   setting.
+// - optionally pointSync true to guarantee points to line up.
+
+// 2. Correct incorrect cyclic:
+// This will usually fail upon loading:
+//  "face 0 area does not match neighbour 2 by 0.0100005%"
+//  " -- possible face ordering problem."
+// - in polyMesh/boundary file:
+//      - loosen matchTolerance of all cyclics to get case to load
+//      - or change patch type from 'cyclic' to 'patch'
+//        and regenerate cyclic as above
+
+
+// Do a synchronisation of coupled points after creation of any patches.
+// Note: this does not work with points that are on multiple coupled patches
+//       with transformations (i.e. cyclics).
+pointSync false;
+
+// Patches to create.
+patches
+(
+    // none
+);
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/decomposeParDict

@@ -0,0 +1,30 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      decomposeParDict;
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+numberOfSubdomains 4;
+
+method          scotch;
+
+hierarchicalCoeffs
+{
+    n               (1 4 1);
+    delta           0.001;
+    order           xyz;
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/fvSchemes

@@ -0,0 +1,63 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    location    "system";
+    object      fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+    default         Euler;
+}
+
+gradSchemes
+{
+    default         Gauss linear;
+    grad(p)         Gauss linear;
+    grad(U)         cellLimited Gauss linear 1;
+}
+
+divSchemes
+{
+    default         none;
+//    div(phi,U)      Gauss upwind;
+    div(phi,U)      Gauss linearUpwind grad(U);
+    div(phi,k)      Gauss upwind;
+    div(phi,epsilon) Gauss upwind;
+    div((nuEff*dev(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+    default         Gauss linear limited corrected 0.33;
+}
+
+interpolationSchemes
+{
+    default         linear;
+}
+
+snGradSchemes
+{
+    default         limited corrected 0.33;
+}
+
+fluxRequired
+{
+    default         no;
+    pcorr           ;
+    p               ;
+}
+
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/fvSolution

@@ -0,0 +1,80 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+    pcorr
+    {
+        solver          GAMG;
+        tolerance       1e-2;
+        relTol          0;
+        smoother        GaussSeidel;
+        cacheAgglomeration no;
+        nCellsInCoarsestLevel 10;
+        agglomerator    faceAreaPair;
+        mergeLevels     1;
+        maxIter         50;
+    }
+
+    p
+    {
+        $pcorr;
+        tolerance       1e-5;
+        relTol          0.01;
+    }
+
+    pFinal
+    {
+        $p;
+        tolerance       1e-6;
+        relTol          0;
+    }
+
+    "(U|k|epsilon)"
+    {
+        solver          smoothSolver;
+        smoother        symGaussSeidel;
+        tolerance       1e-6;
+        relTol          0.1;
+    }
+
+    "(U|k|epsilon)Final"
+    {
+        $U;
+        tolerance       1e-6;
+        relTol          0;
+    }
+}
+
+PIMPLE
+{
+    correctPhi          no;
+    nOuterCorrectors    1;
+    nCorrectors         2;
+    nNonOrthogonalCorrectors 0;
+}
+
+relaxationFactors
+{
+//    "(U|k|epsilon).*"   1;
+}
+
+cache
+{
+    grad(U);
+}
+
+// ************************************************************************* //

tutorials/incompressible/pimpleDyMFoam/oscillatingInletACMI2D/system/topoSetDict

@@ -0,0 +1,89 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| =========                 |                                                 |
+| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
+|  \\    /   O peration     | Version:  dev                                   |
+|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
+|    \\/     M anipulation  |                                                 |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+    version     2.0;
+    format      ascii;
+    class       dictionary;
+    object      topoSetDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+actions
+(
+    // Get both sides of ami
+    // ~~~~~~~~~~~~~~~~~~~~~
+
+    // Create faceZone for patch couple1
+    {
+        name    couple1Faces;
+        type    faceSet;
+        action  new;
+        source  patchToFace;
+        sourceInfo
+        {
+            name    couple1;
+        }
+    }
+    {
+        name    couple1Faces;
+        type    faceZoneSet;
+        action  new;
+        source  setToFaceZone;
+        sourceInfo
+        {
+            faceSet couple1Faces;
+        }
+    }
+
+    // Create faceZone for patch couple2
+    {
+        name    couple2Faces;
+        type    faceSet;
+        action  new;
+        source  patchToFace;
+        sourceInfo
+        {
+            name    couple2;
+        }
+    }
+    {
+        name    couple2Faces;
+        type    faceZoneSet;
+        action  new;
+        source  setToFaceZone;
+        sourceInfo
+        {
+            faceSet couple2Faces;
+        }
+    }
+
+    // Create cellZone for moving cells in inlet channel
+    {
+        name    inletChannel;
+        type    cellSet;
+        action  new;
+        source  boxToCell;
+        sourceInfo
+        {
+            box     (-100 -100 -100) (1.0001 100 100);
+        }
+    }
+    {
+        name    inletChannel;
+        type    cellZoneSet;
+        action  new;
+        source  setToCellZone;
+        sourceInfo
+        {
+            set     inletChannel;
+        }
+    }
+);
+
+// ************************************************************************* //