zhyang-dev/openfoam
1
0
Fork 0
mirror of https://develop.openfoam.com/Development/openfoam.git synced 2025-11-28 03:28:01 +00:00
Code Issues Actions Packages Projects Releases Wiki Activity

Feature moving source

Browse Source
This commit is contained in:
Mattijs Janssens
2024-12-18 17:05:54 +00:00
parent 3d35bb920f
commit e33fb8d0db
10 changed files with 423 additions and 0 deletions
Download Patch File Download Diff File Expand all files Collapse all files

56
tutorials/basic/scalarTransportFoam/moving_source/0/T Normal file
View File

@ -0,0 +1,56 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object T;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 0 0 1 0 0 0];
internalField uniform 0;
boundaryField
{
inlet
{
type uniformFixedValue;
uniformValue
{
type constant;
value 0.0;
}
}
outlet
{
type zeroGradient;
}
upperWall
{
type zeroGradient;
}
lowerWall
{
type zeroGradient;
}
frontAndBack
{
type empty;
}
}
// ************************************************************************* //

45
tutorials/basic/scalarTransportFoam/moving_source/0/U Normal file
View File

@ -0,0 +1,45 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volVectorField;
object U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -1 0 0 0 0];
internalField uniform (0.1 0 0);
boundaryField
{
#includeEtc "caseDicts/setConstraintTypes"
inlet
{
type fixedValue;
value $internalField;
}
outlet
{
type zeroGradient;
}
upperWall
{
type noSlip;
}
lowerWall
{
type noSlip;
}
}
// ************************************************************************* //

4
tutorials/basic/scalarTransportFoam/moving_source/README.txt Normal file
View File

@ -0,0 +1,4 @@
- demo for using moving 'geometric' fvOption selection
- flow left to right
- scalar transport with zero (non-numerical) diffusion
- still too many invocations of selection update

61
tutorials/basic/scalarTransportFoam/moving_source/constant/fvOptions Normal file
View File

@ -0,0 +1,61 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object fvOptions;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
scalarSource1
{
type scalarSemiImplicitSource;
volumeMode absolute;
selectionMode geometric;
selection
{
cylinder
{
action use;
source cylinder;
point1 (0.05 0.03 -1); // beg point on cylinder axis
point2 (0.05 0.03 1); // end point on cylinder axis
radius 0.003;
solidBodyMotionFunction oscillatingLinearMotion;
oscillatingLinearMotionCoeffs
{
// coefficients
amplitude (0 0.02 0);
omega 0.628318530718; // rad/s
}
/*
solidBodyMotionFunction tabulated6DoFMotion;
tabulated6DoFMotionCoeffs
{
// coefficients
timeDataFileName "<constant>/meshMotion.dat";
CofG (0 0 0);
}
*/
}
}
sources
{
T (1e-4 0);
}
}
// ************************************************************************* //

18
tutorials/basic/scalarTransportFoam/moving_source/constant/meshMotion.dat Normal file
View File

@ -0,0 +1,18 @@
4
(
// Time Linear (xyz) Rotation (xyz)
(0 ((0 0 0) (0 0 0)))
(1 ((0 0.02 0) (0 0 0)))
(2 ((0 -0.02 0) (0 0 0)))
(3 ((0 0 0) (0 0 0)))
(4 ((0 -0.02 0) (0 0 0)))
(5 ((0 0.02 0) (0 0 0)))
(6 ((0 0 0) (0 0 0)))
(7 ((0 0.02 0) (0 0 0)))
(8 ((0 -0.02 0) (0 0 0)))
(9 ((0 0 0) (0 0 0)))
(10 ((0 -0.02 0) (0 0 0)))
(11 ((0 0.02 0) (0 0 0)))
(12 ((0 0 0) (0 0 0)))
)

20
tutorials/basic/scalarTransportFoam/moving_source/constant/transportProperties Normal file
View File

@ -0,0 +1,20 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object transportProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
DT 0; //0.01;
// ************************************************************************* //

86
tutorials/basic/scalarTransportFoam/moving_source/system/blockMeshDict Normal file
View File

@ -0,0 +1,86 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object blockMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
scale 0.001;
vertices
(
( 0 0 0)
(100 0 0)
(100 60 0)
( 0 60 0)
( 0 0 1)
(100 0 1)
(100 60 1)
( 0 60 1)
);
blocks
(
hex (0 1 2 3 4 5 6 7) (100 60 1) simpleGrading (1 1 1)
);
edges
(
);
boundary
(
inlet
{
type patch;
faces
(
(0 4 7 3)
);
}
outlet
{
type patch;
faces
(
(2 6 5 1)
);
}
upperWall
{
type wall;
faces
(
(3 7 6 2)
);
}
lowerWall
{
type wall;
faces
(
(1 5 4 0)
);
}
frontAndBack
{
type empty;
faces
(
(0 3 2 1)
(4 5 6 7)
);
}
);
// ************************************************************************* //

48
tutorials/basic/scalarTransportFoam/moving_source/system/controlDict Normal file
View File

@ -0,0 +1,48 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object controlDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
application scalarTransportFoam;
startFrom startTime;
startTime 0;
stopAt endTime;
endTime 10;
deltaT 0.01;
writeControl timeStep;
writeInterval 10;
purgeWrite 0;
writeFormat ascii;
writePrecision 6;
writeCompression off;
timeFormat general;
timePrecision 6;
runTimeModifiable true;
// ************************************************************************* //

50
tutorials/basic/scalarTransportFoam/moving_source/system/fvSchemes Normal file
View File

@ -0,0 +1,50 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object fvSchemes;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
ddtSchemes
{
default Euler; //CrankNicolson 0.9; //Euler;
}
gradSchemes
{
default Gauss linear;
}
divSchemes
{
default none;
div(phi,T) Gauss linearUpwind grad(T);
}
laplacianSchemes
{
default none;
laplacian(DT,T) Gauss linear corrected;
}
interpolationSchemes
{
default linear;
}
snGradSchemes
{
default corrected;
}
// ************************************************************************* //

35
tutorials/basic/scalarTransportFoam/moving_source/system/fvSolution Normal file
View File

@ -0,0 +1,35 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2312 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object fvSolution;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
solvers
{
T
{
solver PBiCGStab;
preconditioner DILU;
tolerance 1e-6;
relTol 0;
norm default;
}
}
SIMPLE
{
nNonOrthogonalCorrectors 0;
}
// ************************************************************************* //