The subtract option in mapFieldsPar was not implemented correctly and the
significant complexity in meshToMesh required to support it creates an
unwarranted maintenance overhead. The equivalent functionality is now provided
by the more flexible, convenient and simpler subtract functionObject.
It is not clear for what cases the minVol control is useful or necessary and for
some cases it causes problems with snapping and layer addition if not set to a
sufficiently small value.
This means the field gets decomposed and reconstructed in the same way
as any other point field, and prevents issues with restart of cases
which feature both mesh motion and topology change.
boundaryProcAddressing has been removed. This has not been needed for a
long time. decomposePar has been optimised for mininum IO, rather than
minimum memory usage. decomposePar has also been corrected so that it
can decompose sequences of time-varying meshes.
Heat power (Q), heat flux (q) and heat transfer coefficient (h)
can now all be specified simultaneously. Their effects will be summed
into a single heat transfer rate. The "mode" keyword is no longer
required.
There is no clear need for a residualAlpha to be defined specifically for Yi and
read from the fvSolution dictionary, the phase.residualAlpha() should be
suitable to stabilise the Yi equations.
The new stabilisation approach avoids any conservation error where the
phase-fraction is greater than residualAlpha by only applying the stabilising
terms to the transport equations in regions where the phase-fraction is less
than residualAlpha.
The defaultPatch type currently defaults to empty which is appropriate for 1D
and 2D cases but not when creating the initial blockMesh for snappyHexMesh as
the presence of empty patches triggers the inappropriate application of 2D point
constraint corrections following snapping and morphing. To avoid this hidden
problem a warning is now generated from blockMesh when the defaultPatch is not
explicitly set for cases which generate a default patch, i.e. for which the
boundary is not entirely defined. e.g.
.
.
.
Creating block mesh topology
--> FOAM FATAL IO ERROR:
The 'defaultPatch' type must be specified for the 'defaultFaces' patch, e.g. for snappyHexMesh
defaultPatch
{
name default; // optional
type patch;
}
or for 2D meshes
defaultPatch
{
name frontAndBack; // optional
type empty;
}
.
.
.
All the tutorials have been update to include the defaultPatch specification as
appropriate.
motionSmootherAlgoCheck::checkMesh is used by snappyHexMesh to check the mesh
after snapping and morphing. The minVol test which checks for collapsed cells
is now relative to the cube of the minimum bounding box length so that it is
less dependent on the size of the geometry and less likely to need changing for
very small geometries.
The default value is set in
etc/caseDicts/mesh/generation/meshQualityDict
etc/caseDicts/mesh/generation/meshQualityDict.cfg
//- Minimum cell pyramid volume relative to min bounding box length^3
// Set to a fraction of the smallest cell volume expected.
// Set to very negative number (e.g. -1e30) to disable.
minVol 1e-10;
The unused minArea and minTriangleTwist tests have been removed
The pre-exponential factor provided to this reaction rate is assumed to
relate to surface area, so the units are kmol/m^2/s/(kmol/m^3)^sum{exp}.
A standard volumentic reaction, by comparison, (e.g., Arrhenius) would
have pre-exponential factor units of kmol/m^3/s/(kmol/m^3)^sum{exp}.
The use of the surface-area-volume ratio has been corrected to conform
to this definition.
The handling of the div(phid,p) term for transonic support in the pressure
equation is now consistent such that conservation is achieved at convergence of
the pressure system irrespective of the scheme chosen for div(phid,p) and the
relaxation of the pressure equation.
The rhoSimpleFoam tutorials have been updated and improved.
Solver for steady or transient buoyant, turbulent flow of compressible fluids
for ventilation and heat-transfer, with optional mesh motion and mesh topology
changes. Created by merging buoyantSimpleFoam and buoyantPimpleFoam to provide
a more general solver and simplify maintenance.
In rhoPimpleFoam, rhoSimpleFoam, buoyantPimpleFoam and buoyantSimpleFoam the
density prediction step at the start of pEqn.H is now consistent between these
solvers and the other compressible solvers. If the density is relaxed in the
corrector it is now also relaxed following the predictor which improves
consistency, stability and convergence.
For transient solvers which support steady operation using the steadyState ddt
scheme the ".*Final" solver settings are now only used for the final PIMPLE
iteration when running transient; for stead running the standard solver settings
are used for all PIMPLE iterations for compatibility with the equivalent steady
solvers. This makes it easier to maintain both transient and steady cases for
transient solvers.
This allows changers to access geometry from the fvMesh on construction.
It also prevents a crash that occurs when a changer loads a field in
which there is a cyclic boundary condition.
Description
Phase turbulence stabilisation
In the limit of a phase-fraction->0 the turbulence properties cannot be
obtained from the phase turbulence model, coupling to the other phase/phases
is required. The phaseTurbulenceStabilisation fvModel stabilises the phase
turbulence properties by adding transfer terms from the corresponding
properties of the other phases when the phase-fraction is less than the
specified \c alphaInversion. This implementation is a generalisation of
the approach used in the Foam::RASModels::LaheyKEpsilon and
Foam::RASModels::continuousGasKEpsilon models to handle phase-inversion and
free-surface flow and can be used with any combination of RAS turbulence
models.
To stabilise the solution of the phase turbulence equations \c
alphaInversion can be set to a small value e.g. 1e-2, but unless the phase
turbulence model is specifically designed to handle phase-inversion and both
continuous and dispersed regimes it may be useful to set \c alphaInversion
to a higher value, corresponding to the phase-fraction at which transision
from continuous to dispersed happens and effectively use the turbulence
properties of the other phase when the phase is dispersed. This is of
course an approximation to the real system and if accurate handling of both
the continuous and dispersed phase regimes is required specially developed
models should be used.
Usage
Example usage:
\verbatim
phaseTurbulenceStabilisation
{
type phaseTurbulenceStabilisation;
libs ("libmultiphaseEulerFoamFvModels.so");
phase air;
alphaInversion 0.1;
}
\endverbatim
Implementation of the interFoam VoFTurbulenceDamping for multiphaseEulerFoam.
In this implementation no distinction is made between a dispersed phase and the
interface so it is formally only applicable when interface compression is used
between the phase and the other phases. Special handling for dispersed phases
may be added in the future.
Description
Free-surface phase turbulence damping function
Adds an extra source term to the mixture or phase epsilon or omega
equation to reduce turbulence generated near a free-surface. The
implementation is based on
Reference:
\verbatim
Frederix, E. M. A., Mathur, A., Dovizio, D., Geurts, B. J.,
& Komen, E. M. J. (2018).
Reynolds-averaged modeling of turbulence damping
near a large-scale interface in two-phase flow.
Nuclear engineering and design, 333, 122-130.
\endverbatim
but with an improved formulation for the coefficient \c A appropriate for
unstructured meshes including those with split-cell refinement patterns.
However the dimensioned length-scale coefficient \c delta remains and must
be set appropriatly for the case by performing test runs and comparing with
known results. Clearly this model is far from general and more research is
needed in order that \c delta can be obtained directly from the interface
flow and turbulence conditions.
Usage
Example usage:
\verbatim
interfaceTurbulenceDamping
{
type interfaceTurbulenceDamping;
libs ("libmultiphaseEulerFoamFvModels.so");
phase water;
// Interface turbulence damping length scale
// This is a required input as described in section 3.3 of the paper
delta 1e-4;
}
\endverbatim
Replaces the local definition of the omega function in
functionObjects::turbulenceFields.
Will also be used in interfacial transfers and coupling in multiphase turbulence
modelling where different turbulence models are used in different phases.
